Use this tab to
enter the toolpath parameters for a Coons patch wireframe toolpath.
This toolpath divides the area bounded by across and along curves
into a series of patches.
Along cut distance
Sets the distance between cuts in the along direction. Stepover is applied to the
longest along boundary. This parameter determines surface smoothness. A smaller increment
takes longer to process, but works well for more extreme surface curvatures. The
more drastic the curvature on the part, the smaller the step size should be. On a
fairly flat surface, you can use a larger cutting distance (for example, 0.150).
Across cut distance
Sets the distance between cuts in the across direction. Stepover is applied to the
longest along boundary. This parameter determines surface smoothness. A smaller increment
takes longer to process, but works well for more extreme surface curvatures. The
more drastic the curvature on the part, the smaller the step size should be. On a
fairly flat surface, you can use a larger cutting distance (for example, 0.150).
Cutting method
Sets the tool motion during the lofted toolpath. Select Zigzag, One way, Circular,
or 5-axis.
Blending
Determines the type of patches created for the Coons toolpath. Linear blending is
recommended on single patch surfaces. Cubic with slope matching blending is recommended
for multiple patch surfaces. Parabolic and cubic blending tend to produce flat spots
on the surface.
Stock to leave
Enter the amount of material to leave on the part model when the operation is finished.
Rapid depth (abs)
Sets the height from which the tool plunges at the rapid speed before it machines
the part at the feed rate. The tool also retracts to this height when moving between
toolpath segments. This parameter is an absolute value.
Compensation in computer
Generates a toolpath with compensation for the tool
radius, but does not allow for tool wear adjustment at the control. Left and Right
offset the tool by its radius; Off causes the tool to cut the center line of the geometry.
Tip compensation
Sets amount of offset to the tool's center or tip for bull-nose and ball (spherical) tools. Used for touching the tool off the part. For multiaxis toolpaths, Tip compensation outputs the tool tip offset as either the tip or the corner radius distance from the tip.
Sync option
Lines up the across and along boundaries. Selecting Manual or Manual/density requires
additional data input.
Along
Cuts in the along direction stepping over in the across direction.
Across
Cuts in the across direction stepping over in the along direction.