Finish Leftover Parameters
Finish leftover toolpaths remove small amounts of material left by a larger tool in a previous operation. Finish leftover makes a single pass through the leftover material. You can create multiple leftover toolpaths using a smaller tool for each toolpath.
Finish leftover adjusts for different Z depths, unlike Restmill toolpaths which cut at constant Z depths, with multiple stepovers and stepdowns.
Total tolerance
Displays the sum of the Cut tolerance, the Line/arc tolerance, and Smoothing tolerance. Click Total tolerance to open the Arc Filter/Tolerance dialog box. Use the options in this dialog box to set parameters for filtering and smoothing toolpath motion within the specified total toolpath tolerance.
Maximum stepover
A smaller maximum stepover value may take longer to generate the toolpath.
Use approximate start point
From slope angle
Sets the minimum slope angle of the surface to determine the steep areas of the part. Only areas between the From slope angle and To slope angle are machined.
To slope angle
Sets the maximum slope angle of the surface to determine the steep areas of the part. Only areas between the From slope angle and To slope angle are machined.
Cutting method
Orients the cutting direction. Select one of the following options:
- Zigzag: Cuts each pass in the opposite direction to the previous pass. A short linking motion connects the two ends.
- One Way: Cuts one direction, steps over to the next cut while making a rapid move to same start side of the cut, and cuts in the same direction as the previous pass.
- 3DCollapse: Cutting requires surfaces that join together, such as a revolved surface, and gradually transitions between cuts.
Hybrid (constant Z cuts above cut off angle, 3d cuts below)
Available when Cutting method is set to One way or Zigzag. Creates tool motion consisting of both 2D and 3D cuts where cuts above the cutoff angle are constant Z, usually the steepest area, and cuts below the cutoff angle are 3D.
Cut off angle
Enabled when Hybrid (constant Z cuts above cut off angle, 3d cuts below) is selected. Defines the hybrid area. Cuts above the cut off angle are constant Z and cuts below it are 3D. A recommended angle is 45 degrees.
Extension length
Enabled when Hybrid (constant Z cuts above cut off angle, 3d cuts below) is selected. Adds additional distance to the cut for the constant Z portion of the hybrid area.
Keep cuts perpendicular to leftover region
Keeping cuts perpendicular can produce an improved finish and reduce tool wear. Non-perpendicular cuts can improve toolpath performance.
Machining angle
Sets the angle for the toolpath relative to the X axis of the current construction plane.
Machining direction
Sets the machining direction of the toolpath. Select one of the following:
- Clockwise: Cuts in a clockwise direction.
- Counterclockwise: Cuts in a counterclockwise direction.
Expand inside to outside
Starts the toolpath in the center of the part and cuts towards the outside.
Depth limits
Sets the minimum and maximum machining depths for the toolpath. Click Depth limits to open the Depth limits dialog box.
Collapse
Allows you to override the automatic settings Mastercam applies to the collapse resolution. Click Collapse to open the Collapse settings dialog box.
Gap settings
Sets the handling of motion when there is a break in the tool motion, such as between two surfaces. Click Gap settings to open the Gap Settings dialog box.
Advanced settings
Sets tool roll motion at sharp corners between surfaces and at the extreme edges of the part, the corner tolerance, and performs checks on solid and surface models. Click Advanced settings to open the Advanced settings dialog box.





