Finish Parallel Steep Parameters
Finish Parallel Steep toolpaths cut the steep areas of the part. You define the steep areas by entering a range defined by the slope angles. Additional parameters let you define a cut extension to allow the tool to plunge into previously cut areas, and to avoid machining areas of the part twice.
Total tolerance
Displays the sum of the Cut tolerance, the Line/arc tolerance, and Smoothing tolerance. Click Total tolerance to open the Arc Filter/Tolerance dialog box. Use the options in this dialog box to set parameters for filtering and smoothing toolpath motion within the specified total toolpath tolerance.
Machining angle
Sets the angle for the toolpath relative to the X axis of the current construction plane.
Use approximate start point
Maximum stepover
A smaller maximum stepover value may take longer to generate the toolpath.
Cutting method
Orients the cutting direction. Select one of the following options:
- Zigzag: Cuts each pass in the opposite direction to the previous pass. A short linking motion connects the two ends.
- One Way: Cuts one direction, steps over to the next cut while making a rapid move to same start side of the cut, and cuts in the same direction as the previous pass.
Cut extension
Adds additional distance to the cut, so the tool can plunge in a previously cut area before machining the steep areas. This extension is added to both ends of the toolpath and follows the curvature of the surface.
From slope angle
Sets the minimum slope angle of the surface to determine the steep areas of the part. Only areas between the From slope angle and To slope angle are machined.
To slope angle
Sets the maximum slope angle of the surface to determine the steep areas of the part. Only areas between the From slope angle and To slope angle are machined.
Include cuts which fall outside
Select to cut the region that falls outside of the steep range angles. Use this checkbox to machine both the steep area perpendicular to the machining angle and the shallow area, leaving the steep area parallel to the machining angle unmachined. Using this method avoids cutting the same area twice.
Depth limits
Sets the minimum and maximum machining depths for the toolpath. Click Depth limits to open the Depth limits dialog box.
Gap settings
Sets the handling of motion when there is a break in the tool motion, such as between two surfaces. Click Gap settings to open the Gap Settings dialog box.
Advanced settings
Sets tool roll motion at sharp corners between surfaces and at the extreme edges of the part, the corner tolerance, and performs checks on solid and surface models. Click Advanced settings to open the Advanced settings dialog box.





