Finish Radial Parameters
Use this tab to define the cutting area for finish radial toolpaths. These surface toolpaths typically cut outward from a central point, like the spokes of a wheel.
After selecting a tool and setting the surface parameters, the Finish Radial parameters tell Mastercam where to start the radial toolpath, how far around to cut (sweep angle), and the angle between each cut.
Total tolerance
Displays the sum of the Cut tolerance, the Line/arc tolerance, and Smoothing tolerance. Click Total tolerance to open the Arc Filter/Tolerance dialog box. Use the options in this dialog box to set parameters for filtering and smoothing toolpath motion within the specified total toolpath tolerance.
Cutting method
Orients the cutting direction. Select one of the following options:
- Zigzag: Cuts each pass in the opposite direction to the previous pass. A short linking motion connects the two ends.
- One Way: Cuts one direction, steps over to the next cut while making a rapid move to same start side of the cut, and cuts in the same direction as the previous pass.
Starting point
Select an option for where to place the start point. Choose either:
- Start inside: Places the start point at the pivot point and cuts towards the outer boundary.
- Start outside: Places the start point on the outer boundary and cuts towards the pivot point.
Maximum angle increment
Sets the maximum angle between each cut. The resulting angle increment may be less than the maximum value because the system divides the toolpath into an integral number of cuts.
Start angle
Sets the angle where the toolpath begins.
Start offset distance
Offsets the center of the surface radial toolpath from a point that you select. If you enter a value for this parameter, you are prompted to select a point after you enter the toolpath parameters.
Sweep angle
Sets the angle (0 to 360) through which the toolpath sweeps, beginning with the start angle. If you enter a negative number, a clockwise sweep angle is created.
Depth limits
Sets the minimum and maximum machining depths for the toolpath. Click Depth limits to open the Depth limits dialog box.
Gap settings
Sets the handling of motion when there is a break in the tool motion, such as between two surfaces. Click Gap settings to open the Gap Settings dialog box.
Advanced settings
Sets tool roll motion at sharp corners between surfaces and at the extreme edges of the part, the corner tolerance, and performs checks on solid and surface models. Click Advanced settings to open the Advanced settings dialog box.





