Quick Rough Parameters
Use the parameters
on this tab to create a quick rough toolpath. This produces the
same type of cutting action as a standard roughing toolpath, but
uses a much simpler set of roughing options.
After entering the basic toolpath dimensions, use the options
in the Rough direction list and select the cutter compensation
options to set the toolpath orientation.
Use Mastercam's standard rough
toolpaths if you need additional roughing options.
Parameters
Rough step
Enter the amount of material to be removed during each cutting pass.
Stock to leave in X
Enter how much stock remains in the X direction when the operation is finished.
Typically, this would be removed by a separate finish operation.
Stock to leave in Z
Enter how much stock remains in the Z direction when the operation is finished.
Typically, this would be removed by a separate finish operation.
Entry amount
Enter the distance from the stock that the tool starts to feed.
Exit amount
Enter the amount that the tool moves beyond the stock boundary at
the end of a cut.
Rough direction
Determines the angle that the tool cuts into the part. This angle is relative to
the rough direction (OD, ID, Face, Back).
Compensation type
Choose how you want to handle cutter compensation:
- Computer: Mastercam computes the compensated toolpath and does not output control
codes for compensation.
- Control: Mastercam outputs control codes for compensation and does not compute the
compensated toolpath.
- Wear: Mastercam both computes the compensated toolpath and outputs control codes
for compensation. Compensation direction in the computer and control are the same.
- Reverse wear: Mastercam both computes the compensated toolpath and outputs control
codes for compensation. Compensation direction in the computer and control are opposite.
- Off: Mastercam programs the tool tip directly on the chained geometry and does not
output compensation codes.
The options that are available to you are determined by the active control definition.
Optimize cutter compensation in control
Eliminates arcs in the toolpath that are less than or equal to the radius of the
tool and helps prevent gouging. The default setting for this field is set on the
Cutter Compensation, General page in the Control Definition.
This field is available only when Cutter compensation is set to Control on the parameters tab, and applies only to that setting.
Compensation direction
Choose to offset the tool to the right or left of the toolpath. Even if cutter compensation
is set to Off, Mastercam uses this setting to determine the orientation of other
toolpath features such as multiple passes.
Lead in/out
Select to have Mastercam add lead in/out moves to the toolpath. Click
to edit the moves.
Stock recognition
Choose how to adjust the area of the stock to be removed by the roughing
operation. The following options are available:
- Remaining stock: uses only stock remaining from previous operations.
- Use stock for outer boundary: uses a section of the stock boundary as the outer boundary.
- Extend contour to stock only: linearly extends the ends of the chained contour to
the stock.
- Disable stock recognition: disables Stock recognition.
Adjust stock
Opens the Adjust Stock dialog box and lets you adjust the area of the stock to be
removed by the roughing operation. This option becomes available only if:
- stock boundaries are defined in the machine group properties
- the chained contour lies entirely within the stock boundary
- either the Use stock for outer boundary or Extend contour to stock only options are
selected.
Linearization tolerance
Only available when chaining splines.
Used when converting 3D arcs and 2D or 3D splines in the chained geometry from curves
to lines. Smaller linearization tolerance values make more accurate toolpaths, but
may take longer to generate and create a longer NC program.