Cut Parameters: Thread Contour dialog box
Use the Cut Parameters, Thread Contour dialog box to enter toolpath and cutting parameters for a Thread Contour toolpath.
Equal area
The thread is made so that equal amounts of material are removed with each cut. This option is enabled/disabled in the control definition.
Equal depths
The thread is made so that the depth of each cut is equal. This option is enabled/disabled in the control definition.
Amount of last cut
Determines the amount of stock to be removed with the last cut. The last cut is an additional cut made before spring cuts. This number is expressed as an incremental radius. Enter a value in the text box.
Number of starts
Enter the number of leads or start points you wish to create.
Number of spring cuts
Spring cuts remove material that remains because of tool or part deflection. Enter a value to determine how many passes the tool needs to make at the finish depth. Little or no material is removed. All passes are made at the same depth.
Amount of first cut
Determines the amount of stock to be removed with the first cut. This is expressed as an incremental radius. The number of cuts it takes to remove all of the stock is determined from the amount of the first cut, the amount of last cut, the thread shape, and the depth of the thread.
Number of cuts
Determines how many cuts the tool will make to cut the stock.
Acceleration clearance
Determines the distance necessary for the tool to accelerate to full speed in the Z direction before it starts cutting the thread. This is an incremental distance from the start of the thread along the Z axis. The distance is set automatically if you check Compute. Select units or revs to tell Mastercam which type of value you entered.
Compute
Check to disable the entry field and have Mastercam calculate the required acceleration clearance from the lead and main spindle speed using the formula = (4) (lead) (speed)/1800.
Stock clearance
Determines how far above the top of the stock the tool retracts between passes. This is an incremental amount. Enter a value in the text box.
Overcut
Determines how far past the end of the thread the tool goes before retracting. Select units or revs to tell Mastercam which type of value you entered.
Lead-in angle
Determines the angle that the tool enters the part on each pass. This value is disabled if you are using the box threading cycle.
Finish pass allowance
Determines the amount of stock to leave for spring cuts. This number is expressed as an incremental radius.





