Feed: Control Definition Manager
Use this page to
tell the post how to interpret the feed rate values that are entered
for each operation.
For Mills and Routers, do the following:
- Choose the axis group which applies
to your machine: 3-axis, 4-axis, or 5-axis. You only need
to fill in the section which applies to your machine. Fill
in more than one section if this control can be selected for
more than one type of machine.
-
Tell Mastercam how the units for
the feed rate are dimensioned. Set the dimensions separately
for linear and rotary feed rates.
For Wire machines,
you can choose to output a feed rate code in the NC file. Mastercam
will output the feed rate specified in the power library selected
for an operation.
For all machine types, you can choose to output rapid moves
as linear moves at the maximum feed rate. You can also choose
to adjust feed rates for arc moves to maintain a constant chip
load.
NOTE
- Many controls don't have the internal
logic to support these features.
- Use the machine
definition to set the actual values for the maximum and
minimum feed rates, including the minimum feed rate for arc
moves.
Parameters
Unit/min
Expresses the feed rate in distance unit per time. You can select these dimensions
for rotary motion as well, in which case it is interpreted as distance along the
arc per minute.
Use inverse
Expresses the feed rate in amount of time per unit of distance.
Degree/min
Expresses a rotary feed rate in units of degrees per minute instead of distance along the arc.
Feed rate in minutes/seconds
Select the proper time scale for your feed rates.
Convert rapid to maximum feed rate
Select this option to have G0 moves output as G1 moves at the maximum feed rate. The
maximum feed rate is set in the machine definition.
Adjust feed rate on arc moves
Adjusts the feed rate to maintain a constant chip load at the peripheral edge of
a milling tool or the radius of a turning tool where they contact the stock. For
example, Mastercam might speed up the tool on the outside of an arc, or slow it down
inside an arc.
Use feed rate in NC output
Select this option to pass feed rate information from the wirepath to the post processor.
Right-click
menu options
Default
Reset either the current
page or the entire control definition to the default values.
Import
Import values for either
the current page or all pages from a different control definition. However, importing
values will not change the following:
- selected post processor, control
type, and name
- toolpath/operation defaults
- post text
- miscellaneous integer
and real values
You can import
post text and miscellaneous values from the Text page.