Mastercam Toolpath Guidelines for ATP
When creating part files and toolpaths that will be used in an Automatic Toolpathing (ATP) strategy, consider the following guidelines:
- ATP supports the following 2D toolpath
types:
- Contour
- Drill
- Block Drill
- Helix Bore
- Thread Mill
- Circle Mill
- Engrave
- ATP does not support tool planes. If you have parts that require tool planes, create the operations separately, and do not include them in the operation library you use in strategies.
- When processing files, ATP requires that each mapped level in each file have a closed chain geometry at ZØ. For 2D parts, make sure the geometry is set at ZØ. For 3D parts, make sure the top of the geometry is set at ZØ. If those depth requirements are not met, ATP will abort processing the file(s), and you will receive a message stating that there was a problem toolpathing the current file.
- Use a separate level for the part geometry used in each toolpath so that each level will have only one operation. Name the levels with titles that describe the contents for easy recognition when you create strategies. For example, for a cabinet panel that requires both contour and drill toolpaths, put the geometry to be contoured on one level, and the holes to be drilled on another.
- When saving toolpaths to an operation library, name the library to match the file names of the level group and strategy. Matching file names and making those names descriptive will make it easier to match levels to toolpaths and map strategies to files. You can also title operations libraries by customer or job to make them easy to identify.
-
When setting up the toolpath, always chain the part in a clockwise direction. Make sure to always set Compensation direction to Left on outside cuts and to Right on inside cuts. This ensures that all operations brought into strategies will be consistent.
-
After your strategies are created and you are setting up files to process, you can reverse the chaining direction and cutter compensation direction using the Conventional Cutting Direction checkbox in the Cutlist area of the Mastercam ATP dialog box. Select the checkbox to set a conventional cutting direction. Deselect it to set a climb cutting direction.
-
When setting the toolpath parameters in the Toolpath Parameters tab of the toolpath dialog box, make sure to enter a description of the toolpath in the Comment field . ATP uses this text as the name of the operation in setting up a strategy.
-
When setting the toolpath parameters in the Parameters tab of the toolpath dialog box, such as in the Contour Parameters tab, make sure the compensation type is set to any choice other than Off.
-
When setting the lead in and out parameters in the toolpath's Lead In/Out dialog box tab, make sure the entry and exit points are set to the midpoint of the geometry rather than on a corner to avoid possible chipping.
-
When exporting a toolpath to an operation library, make sure Export operation’s geometry is not selected.
- When different levels contain identical geometry, you can apply the same operation to each instance of identical geometry.





