Nesting Options: ATP
Use the Nesting Options, ATP dialog box to define nesting parameters for the current ATP job. Select either Rectangular or TrueShape for the mode of operation, set the nesting sorting parameters, and choose the program control options.
Rectangular nesting places a bounding box around the part and uses the box as the part boundary for nesting. Rectangular nesting also places a bounding box around an irregular sheet, and nests parts within that boundary even if the bounding box extends beyond the sheet boundaries.
TrueShape nesting fits parts or toolpaths on a sheet based on shape and other parameters. It allows access to sheet and part libraries and extended functionality beyond Rectangular nesting. TrueShape nesting creates copies of the part or toolpath and fits them together using the part shape, a rotation angle, reversing the copy (mirror), and other parameters. It increases the yield of parts from a sheet of material. TrueShape nesting also allows nesting on irregularly shaped sheets by placing parts or toolpaths within the sheet boundary regardless of the shape of the sheet.
Nest toolpaths
When selected, allows parts to be nested. This radio button is specific to Mastercam parts. Deselecting this checkbox disallows nesting but still applies toolpaths to each part.
Part-part distance
Controls the spacing between geometry parts or toolpaths in a nesting session. Enter the minimum amount of space between nested parts, allowing at least the diameter of the cutting tool you are planning to use as the distance between parts.
Sheet margin
Enter the amount of space between the edge of the sheet and the nested parts. When nesting geometry, be sure to enter a wide enough margin to accommodate toolpaths.
Use the sheet margin to allow enough space to keep the tool buried in the material when cutting parts close to the edge of the sheet, or to keep parts from contacting damaged edges of a sheet. Sheet margin can be used in addition to part margin to create adequate spacing (Nesting combines both values).
Accuracy
Determines the precision of the results. The finer the accuracy, the longer the results may take to generate. Each of the predefined accuracy settings corresponds to a resolution value, for example, Fine = .025. Use a larger setting such as Coarse for bigger parts. If available, choosing User Defined enables the resolution field where you can enter the resolution for the results.
There may be cases where a finer accuracy setting may not produce optimum results, for example if the parts are big.
Nesting corner
Choose the corner of the sheet where Nesting will begin positioning parts. Changing the nesting corner can sometimes improve material usage.
Fill direction
Determines the direction in which the sheet is filled with nested parts. A sheet's fill direction runs perpendicular to the part's nesting direction. For example, if you select an Upper Left start point in the Nesting corner field and a Horizontal direction in the Fill Direction field, Mastercam does the following:
- Places the first part in the upper left corner of the sheet
- Nests the parts vertically down the left side.
When the nested parts reach the bottom of the sheet, the next column of parts is positioned to the immediate right of the parts already nested filling the sheet from left to right.
Use this parameter to control drop and improve material usage. Choose Calculate to have Mastercam apply the most efficient fill direction.
| Fill Direction (Horizontal) | Fill Direction (Vertical) |
|---|---|
|
|
Guillotine
(TrueShape nesting only) Arranges the nested parts so that straight cuts across the material can be made.
Automatic sheet origins
Select to have Mastercam automatically place the sheets at different locations in the graphics window. When deselected, you need to set a unique origin for each sheet to keep Mastercam from placing them in the same position.
Sheet-sheet distance
Enter the distance between the sheets placed in the graphics window.
Sheet margin
Enter the amount of space between the edge of the sheet and the parts. If you enter 0 for the Sheet margin, Mastercam nests parts to the very edge of the sheet. Toolpaths may extend over the sheet boundary.
Common Geometry Nesting Controls
Common Toolpath Nesting Controls
Determines the direction in which the sheet is filled with nested parts. A sheet's fill direction runs perpendicular to the part's nesting direction. For example, if you select an Upper Left start point in the Nesting corner field and a Horizontal direction in the Nesting direction field (as shown below), Mastercam Places the first part in the upper left corner of the sheet Nests the parts vertically down the left side. When the nested parts reach the bottom of the sheet, the next column of parts is positioned to the immediate right of the parts already nested filling the sheet from left to right.
Use Fill direction to control drop and improve material usage. Choose Calculate to have Mastercam apply the most efficient nesting/fill direction.
Rectangular
Nests parts as rectangles on a grid. TrueShape nests parts according to each part's actual shape and other parameters.
TrueShape
TrueShape nests parts according to each part's actual shape and other parameters.
Database order
Sorts the operations in the order they were placed on the sheet.
Maximum vacuum
Sorts the operations by size (smallest parts first), and then inside parts before outside parts to maintain as much vacuum coverage as possible.
Drilling is always done first.
Tool number ascending
Sorts the operations starting with the operation that uses the lowest tool number.
Tool number descending
Sorts the operations starting with the operation that uses the highest tool number.
Minimize tool change
Sorts the operations by tool so that all parts using one tool are cut before changing to the next tool.
Off (separate file for each sheet)
When selected, outputs sheets to the NC file without program stops.
Stop
When selected, inserts a program stop (M00) between sheets.
Optional stop
When selected, inserts an optional stop (M01) between sheets.
Onion skin
Select to enable any onion skin settings in toolpaths that will be processed with ATP.
Common edge
When you enable Common Edge, the nesting function can position parts so that they share parallel edges. This allows a single pass to cut two edges simultaneously.
Create block drill operations
Creates a new block drill operation for each sheet generated when nesting block drill toolpaths. When you nest a block drill toolpath with this option chosen, the nesting operation posting is turned off in the Toolpaths Manager, and each new block drilling operation is inserted directly below the nesting result (as shown below). A new block drill operation will be created for each nesting result (sheet used).





