Tool: Control Definition Manager
Use this page to
set defaults for tool offsets, numbering, and home positions.
Tool offsets
Choose how to transmit tool offset information to the post.
You can use either of two methods:
- Read tool offsets directly from
the tool definition (From tool).
- Create offset numbers based on the
tool number plus the numbers you enter here (Add
to tool).
Tool numbers
Select the options which describe how your post handles tool
numbers and head/station numbers.
Home position
The home
position is where the tool goes for tool changes. The home
position can be set in several different places:
- The machine definition
- The tool definition (Lathe)
- As part of the parameters for an
individual operation
Use this section to set the default source of the home position.
You will still be able to override this setting on an operation-specific
basis.
This page applies
to Mill, Lathe, Router, and Mill-Turn machine types (some of the
field labels are slightly different for Lathe). For Mill-Turn
machines, you will be able to access separate pages for your mill
and lathe tools.
Parameters
Add to tool
Select this option to have Mastercam calculate the tool offset number to output at
each tool change. To calculate each offset, Mastercam will add the number you enter
here to the tool number.
From tool
Select this option to have Mastercam read the tool offset numbers stored in the tool
definition.
Write length register to NCI with lathe toolpaths
Select this option so that length registers for lathe tools are written to the NCI
in the same way as mill tools.
Use the head/station number to replace the tool number
Select this option to replace the tool number with the head number (Mill or Router toolpaths) or station number (Lathe toolpaths). In the post, the tool number will
be written from the lstation$ variable instead of t.
Use the head/station to add for the offset registers
If you choose to calculate the value of an offset register instead of using the value
stored in the tool definition, this tells Mastercam to use the head or station number
instead of the tool number.
Enable staged tool routines
Select this option if your machine has a tool changer capable of pre-staging tools
and you wish to use those routines. This instructs the post to build and use tool
tables and related preparatory blocks by setting the bldnxtool$ post variable. It
is your responsibility to ensure that your post is written to properly process this
variable.
Default home position option
Choose the default source of the home position. Users will be able to override this
setting in the Toolpath parameters when creating or editing a toolpath.
Right-click
menu options
Default—Reset either the current
page or the entire control definition to the default values.
Import—Import values for either
the current page or all pages from a different control definition.
However, importing
values will not change the following:
- selected post processor, control
type, and name
- toolpath/operation defaults
- post text
- miscellaneous integer
and real values
You can import
post text and miscellaneous values from the Text
page.