Simulator Options
Use the Simulator Options dialog box to set options before running Mastercam Simulator.
This topic does not apply to Mill-Turn.
This page contains options for stock, stock boundaries, and fixtures.
Stock setup
Uses stock boundary information from the Stock Setup dialog box to determine stock boundaries.
Scan toolpaths
Determines stock boundaries from tool movements.
Use stock setup values
Uses stock boundary information from the Stock Setup dialog box to determine stock boundaries.
Pick stock corners
Returns you to the graphics window to pick the corners of the stock from the current geometry.
Box
Displays the stock in a rectangular box shape.
Cylinder
Displays the stock in a cylindrical shape.
Cylinder axis
Sets the center axis of the cylinder to the X, Y, or Z axis.
Cylinder diameter
Sets the cylindrical stock diameter.
Center on axis
Rotates the stock and toolpath around the selected center axis.
Solid/Mesh
Uses a solid model or mesh in the current part file as the stock. Click Select to return to the graphics window to select the solid or mesh.
File
Use a solid model from an STL file as the stock. Select a file from the drop-down list or choose Select to navigate to another folder and search for files.
Stock model
Uses a stock model operation from the drop-down. Mastercam lists all stock model operations defined in the current part file.
Fixtures
Enables the use of fixtures in Mastercam Simulator. Fixtures can be used for collision checking.
Levels
Sets the levels on which the fixtures are located.
Solids/Meshes
Uses solids, surfaces, or meshes in the current part file as the fixtures. Click Select to return to the graphics window to select the solids, meshes, or surfaces.
File
Uses a selected file as the fixture shape.
Restore settings
Resets settings in this tab to their default values.
This page provides options for compensation and tolerances.
Cutter compensation in control
Allows you to view simulated cutter compensation during the verification process, if you selected cutter compensation in control in the toolpath.
True thread mode
Simulates accurate threads. Deselect to display threads as concentric circles and grooves, which allows Mastercam Simulator to run faster but less accurately.
Curve tolerance
Sets the tolerance for tool simulation when following a curve.
STL tolerance
Sets tolerance for saved STL files. This option also affects your tool display in Mastercam Simulator. A larger value displays a coarser tool.
Workpiece tolerance
Adjusts the quality of the workpiece displayed during simulation. A smaller tolerance value produces a smoother workpiece. You can also use this option to match the workpiece tolerance to the stock tolerance when comparing your verification results.
Rotary arc smoothing
Applies a scale factor to smooth rotary moves to reduce noise and waves. You can enter between 1 to 100. The higher the scale factor, the smoother the segments become. This option only affects toolpaths using the options in the Rotary Axis Control page in the toolpath dialog box.
| Rotary arc smoothing set to 1 | Rotary arc smoothing set to 100 |
|---|---|
|
|
Restore settings
Resets settings in this tab to their default values.
This page provides options for the machine and posting.
Machine
Select the machine to be simulated. Note that the only machines available are those in the \Shared Mastercam 2023\machine simulation\machsim folder. If no machine is selected, the machine set in the Simulation tab of the Machine Simulation dialog box will be used.
For more information on adding a new machine, refer to the Adding a New Machine Help topic or contact your local Mastercam Reseller.
Post settings
Opens the Machine Simulation dialog box, where you can set up post options before running Mastercam Simulator.
Use external post
Uses an external post instead of a generic post when simulating toolpaths. By using your own posts, you can view a more realistic simulation. The selected Machine must contain a *.pst file.
To modify your post, you must have a license to do so. Contact your Mastercam Reseller for more information.
Position
Allows you to transform the geometry a specified amount on each axis. You can enter the X, Y, and Z translation values manually or by selecting from the screen. Set to Automatic to allow Mastercam to handle the position.
Transform into WCS
Positions the workpiece to match the Working Coordinate System settings entered in the operation's Planes or Toolpath Coordinate System dialog boxes.
Arc curve tolerance
Enter the tolerance for arc curves when in Simulation.
Tool Center Point Control
Enables a linear interpolation around the tool tip position or around the rotational spindle head. Use this option when there are large jumps in the rotational axis or singularities in the code that cause faults.
Maximum distance
Sets the maximum segment length to create interpolated points between calculated moves.
Maximum angle change
Sets the maximum angle difference for interpolated moves between calculated moves.
Restore settings
Resets settings in this tab to their default values.





