Cutter Compensation
Tool compensation adjusts the toolpath to allow for the cutting tool’s radius. The tool can be offset to the right or left of the geometry, with respect to the chaining direction used when selecting the geometry.
Mastercam offers five cutter compensation options.
- Computer - Use this option to have Mastercam automatically calculate the compensated tool positions based on the tool dimensions that are stored in the tool library. When you post the operation, the NC file will contain the compensated positions directly, instead of G41/G42 codes. This option does not allow the machine tool operator to adjust for tool wear at the control. After selecting Computer as the Compensationtype, choose either Right, Left, or Auto to orient the tool on the proper side of the geometry. The specific direction options that are available depend on the type of toolpath.
- Auto - This option is only available for Mastercam Lathe. It lets Mastercam choose the compensation direction itself, and is typically used when there are multiple chains that might require different compensation directions.
- Control - Use this option to have the control calculate the compensated positions instead of Mastercam. Selecting this option will output G41/G42 codes to turn the compensation on. The compensation amount or tool wear adjustment is set at the control. If your control supports 3D cutter compensation (used for multiaxis toolpaths), you can select it by choosing this option, but your post needs to be specially configured to produce the proper code. Note: Cutter compensation in control is not supported for remachining toolpaths.
- Wear - When this option is selected, Mastercam calculates the compensated tool positions just as if Computer was selected, but also outputs the G41/G42 codes. This lets the operator adjust for tool wear at the control. Enter the difference between the selected tool size and the reground tool size at the control as a negative number.
- Reverse Wear – This works just like the Wear option except that the wear adjustment is entered as a positive number.
- Off – Mastercam does not adjust tool positions for the size of the tool and does not output any compensation codes. Even when Off is selected, you can select a compensation direction, which Mastercam uses to orient lead in/out moves.
The actual list of compensation options available to you is determined by the active control definition. Use the Cutter compensation page to configure the options that are supported by your control.
When Compensation type is Off, Mastercam does not take any tool dimensions into account when computing the toolpath. This may lead to the tool gouging the part.
When you select the tool, Mastercam analyzes the tool and chooses which compensation direction is most likely to be correct, and sets this as the default. You can change this when you set the other operation parameters.
To use the Control, Wear, or Reverse wear options correctly, make sure that your toolpath includes a move at the beginning and end of the toolpath to turn compensation on and off correctly. You can accomplish this in several ways:





