Filter Settings: Engraving
Use the Filter Settings dialog box to set parameters for Engraving toolpath filtering (toolpath optimization), which includes:
- Tolerance for replacing multiple linear tool moves with a single move
- Mastercam adds the filter cut tolerance to the precision tolerance that is set on the Roughing/Finishing tab. If you set a .001 cut tolerance and a .001 precision tolerance, the total tolerance will be .002.
- Number of points Mastercam looks ahead when filtering a toolpath
- Minimum and maximum arc radius.
- Optional replacement of linear moves with arcs
Cut tolerance
Adjusts the level of precision of the toolpath. A tighter tolerance (smaller value) produces more NC code. A looser tolerance (bigger value) is appropriate for creating a roughing operation to be followed by a remachining operation.
Look ahead
Mastercam looks at the specified number of points at a time to filter the toolpath. Decreasing the number of points may increase the filter speed but reduce optimization.
Create arcs
Select to replace points in the toolpath with arcs in addition to lines. Mastercam determines if arcs or lines have a lower tolerance and adjusts the toolpath accordingly. Deselect so that the filter uses only lines to adjust the toolpath.
When you select Create arcs, the filter may create arcs in the XY, XZ, and YZ planes. If your post processor is not configured to handle arcs in all three planes (usually designated as G17, G18, and G19 in the NC code), then clear the Create arcs checkbox.
Minimum arc radius
Enabled when Create arcs is selected. Determines the minimum radius of any arc added to the toolpath by the filter. If an arc is smaller than the minimum arc radius, Mastercam adds lines to the toolpath in place of the arc. You cannot enter a value that is not compatible with the current control definition.
Maximum arc radius
Enabled when Create arcs is selected. Determines the maximum radius of any arc added to the toolpath by the filter. If an arc exceeds the maximum arc radius, Mastercam adds lines to the toolpath in place of the arc. You cannot enter a value that is not compatible with the current control definition.





