Lead In/Out
Use the Lead In/Out page to create lead in/out moves for toolpaths that have a tree view list of pages for Mill or Router toolpaths.
- Your lead in/out move can include both lines and arcs. To use an arc only, enter a line length of 0. To use a line only, enter an arc radius of 0.
- Enter arc or line dimensions as either absolute values or a percentage of the tool diameter. When you make an entry in one field, the other automatically updates.
-
Use Copy to copy Entry values to the Exit section or Exit values to the Entry section.
-
Use Swap to swap Entry and Exit values.
Lead in/out moves are a combination of lines and arcs at the beginning and end of a Contour toolpath that control how the tool approaches and pulls away from the toolpath. Mastercam places entry and exit lines relative to the entry and exit arcs. If both an entry line and an entry arc are defined, the line gets machined first. If both an exit line and an exit arc are defined, the arc gets machined first. The angle of entry/exit ramps is determined by the line length and ramp height.
You can change the lead in/out settings by double-clicking Parameters in the Toolpaths Manager, and then choosing Lead In/Out nested under Cut parameters.
- You can override the toolpath feed rate by setting feed rates for both lead in and lead out.
- The contour lead in/out options are available for all contour types.
- If you use an entry point and an exit point for the lead in/out moves, Mastercam uses the entry point for both points, which is the last point chained before the toolpath chain.
| Icon | Name | Description |
|---|---|---|
|
Detect (FBM Drill) | Analyzes the solid model and detects features based on the Feature Based Machining (FBM) operation's current parameters. View the results of all detected features and their machining information in the Features page. For more information, please refer to Detection States and Modes in FBM. |
|
Reselection is not available | Hole Wizard features for a Wizard Holes operation can only be selected in Mastercam for SOLIDWORKS. Contact your Reseller for more information. |
|
Preview toolpath operations (FBM Drill/Wizard Holes) | Opens the Toolpath Operations Preview dialog box where you can view the list of operations FBM will generate using the current Features page list. |
|
Save parameters to defaults file | Makes the current toolpath settings the default for future toolpaths of this type. Saves the current values in the toolpath properties pages to the .mcam-defaults file specified in the machine group properties. |
|
Reload parameters from defaults file | Overwrites the current values in the toolpath properties pages with the toolpath's default parameters. These parameters are reloaded from the .mcam-defaults file specified in the machine group properties. |
|
Hide dialog | Minimizes the dialog box so that you can use other Mastercam functions, like changing your shading settings or the graphics window view. When finished, press [Esc] to maximize the dialog box. |
|
Tool Manager | Opens the Tool Manager. Use the Tool Manager to create and edit tool definitions and to work with tool libraries. When you close the Tool Manager, the toolpath dialog box will reappear just as you left it. |
|
Feed speed calculator | Opens the Feed & Speed Calculator dialog box where you can modify the calculated feed rate or spindle speed by adjusting the material and tool parameters. |
|
None |
Page window | This window displays all of the pages that are available to you, depending on the selected toolpath type. A green check mark indicates pages where data has changed in the current session. |
| None | Quick View Settings | This window summarizes key toolpath information from the Tool page, Coolant page, and Planes page. It updates automatically as you make changes to the different pages and is always visible. |
| None | Generate toolpath | When selected, automatically generates the toolpath when you click OK. For more information, refer to Accepting and Generating Toolpaths. |
|
OK | Generates the toolpath and closes the dialog box. If editing a toolpath, applies the changes and closes the dialog box. |
|
Apply | Applies your changes to the toolpath without closing the dialog box. |
|
Cancel | Closes the dialog box and cancels the toolpath creation. If editing a toolpath, any changes to the toolpath are discarded. |
Not all options are available for all toolpaths.
Enter/Exit at midpoint in closed contours
Starts and ends a toolpath with closed chains at the midpoint of the first chained entity.
Gouge check entry/exit motion
Ensures that the entry/exit moves do not gouge the part. If the entry/exit moves cause a gouge, they are removed from the toolpath.
Overlap
Sets how far the tool goes past the end of the toolpath before exiting for a cleaner finish.
Entry
Mastercam lets you create a lead in move, a lead out move, or both. Select Entry to create an entry move and turn on the Entry options.
Exit
Mastercam lets you create a lead in move, a lead out move, or both. Select Exit to create an exit move and turn on the Exit options.
Profile ramp
Creates an entry or exit move that follows a ramp motion. Instead of a straight line, the tool will track around the contour of the profile as it enters or exits for a smoother transition in or out of the cut.
Perpendicular
Rotates entry or exit lines 90 degrees towards the cutter compensation direction.
Tangent
Places entry or exit lines tangent to the cut direction.
Line length
Sets the line length for entry or exit lines. Enter a percentage of the tool diameter or an exact length. Mastercam automatically updates the other field when you enter a value in one of them. Set to 0 if you just want an entry arc and do not want an entry line.
Ramp height
Adds a depth to the entry or exit line, turning the line into a ramp. Set to 0 for no ramp height.
Arc radius
Defines the entry or exit arc's radius. The arc is always tangent to the toolpath. Enter a percentage of the tool diameter or an exact length. Set to 0 if you just want an entry line and do not want an entry arc.
Sweep
Sets the sweep angle of the entry or exit arc.
Helix height
Adds a depth to the entry or exit arc, which turns the arc into a helix. Set to 0 for no helix height.
Use entry/exit point
Uses the last point chained before the toolpath chain as the start point for entry moves, and as the exit point for exit moves.
Use point depth
Starts the entry/exit move at the depth of the entry/exit point.
Exit on last depth cut only
Adds exit moves only to the end of the last depth cut.
Enter on first depth cut only
Adds enter moves only to the start of the first depth cut.
Plunge after first move
Allows you to turn on cutter compensation during the first tool move before plunging into the part. Helps to avoid encountering clamps and fixtures before cutter compensation is on. If unselected, cutter compensation is turned on at the first cut depth for the toolpath.
Retract before last move
Allows you to turn off cutter compensation during the last tool move after retracting from the part. Helps to avoid encountering clamps and fixtures before cutter compensation is off. If unselected, cutter compensation is turned off at the last cut depth for the toolpath.
Override feed rate
Specifies a feed rate for the entry or exit move. You may want to reduce the feed rate because the tool is entering the material. Select the checkbox to activate the option and enter a feed rate.
If Adjust start/end of contour is selected, Mastercam adjusts your toolpath as necessary. If Extend is selected, lead motion is added and the entered Override feed rate is applied. If Shorten is selected, the machining passes are adjusted.
Adjust start/end of contour
Adjusts the length of the toolpath. You can make it either longer or shorter. If you create an additional entry or exit move, it will be relative to this adjusted position.
If Override feed rate is selected, the entered feed rate is applied to any lead motion.
Length (Adjust start/end of contour)
Sets the line length by which the beginning of the toolpath is extended or shortened. Enter a percentage of the tool diameter or an exact length.
Extend
Adds the specified length to the beginning or end of the toolpath.
Shorten
Removes the specified length from the beginning or end of the toolpath.





