Parameters: Toolpath Nesting
Use this tab to provide more information about how you want operations nested.
You can create marking operations that will be output before other operations. Create a contour or engrave toolpath and choose a center drill tool. Mastercam recognizes this type of toolpath as a marking operation and always outputs it first, regardless of the sorting method chosen.
Sorting method
Mastercam offers several options for ordering the output of operations. Marking operations will be machined first regardless of the sorting method chosen.
- None (nested order): Sorts the operations in the order that the parts were placed on the sheet.
- Database (operation manager order): Sorts the operations using the order in the Toolpaths Manager.
- Next closest: Sorts the operation by location, beginning with the start point that you select.
- Maximum vacuum: Sorts the operations by size (smallest parts first) and then inside parts before outside parts to maintain as much vacuum coverage as possible. Use the checkboxes to reorder chains within source operation and/or to reorder operations within clusters. Clusters are parts that are grouped and treated as a unit.
- Tool number (Ascending/Descending): Outputs the operations by tool number, in ascending or descending order.
- Minimum tool change: Sorts the operations by tool so that all parts using one tool are cut before changing to the next tool. This option overrides any of the other sorting options. Minimum tool change breaks up part clusters that use more than one tool.
- Advanced: Opens the Advanced Sorting dialog box so that you can divide a sheet into regions for sorting operations.
Stop condition
Use program stops or optional stops to allow the machine operator to change material.
- None (separate file for each sheet): Outputs the sheets to the NC file without program stops.
- Stop: Inserts a program stop (M00) between sheets.
- Optional Stop: Inserts an optional stop (M01) between sheets.
Create new operations and geometry
Copies geometry and operation parameters from the source operation to each location, and creates an entry for each operation in the Toolpaths Manager.
Work offsets
Control work offsets when the nesting operation uses multiple sheets.
-
One work offset for all instances of a sheet: Positions the tool origin at the lower left corner of the first sheet in the nesting session and outputs a single work offset. The sheets are then named, starting with #1 on the left to #3 on the right.
-
One work offset for each instance of a sheet: Repositions the tool origin at the lower left corner of the sheet for each sheet in the nesting session and outputs a work offset for each sheet. The sheets are then named, starting with #1 on the left to #3 on the right. For this option to be effective, you must select the Assign new method in the Advanced Offsets dialog box.
- Advanced: Opens the Advanced offsets dialog box so that you can to customize work offsets for the nesting operation.
Common Toolpath Nesting Controls
Save defaults
Saves all settings in the Parameters tab to the nesting defaults file (NESTING.DEFX or NESTING-MM.DEFX).
Load defaults
Retrieves Parameters tab settings from the nesting defaults file.





