Roughing/Finishing: Engraving
Use the Roughing/Finishing tab to set roughing and finishing parameters for your Engraving toolpath.
A roughing operation removes material from a cavity. Although engraving toolpaths do not require roughing, you can use roughing to clean out cavities as an alternative to pocketing. Engraving generates a contour-like finish pass as part of the roughing operation.
Remachining toolpaths always use the zigzag cutting pattern.
Rough
Select to enable roughing parameters, activate default values, and select a cutting method. Deselect if you only want to create a finish pass. Rough cutting methods are unavailable for Remachining toolpaths because remachining uses only the zigzag cutting method. Select one of the following methods:
- Zigzag: Roughs the Engraving toolpath in a linear motion according to the roughing angle.
- One way: Roughs the pocket in one direction.
- Parallel spiral: Roughs the Engraving toolpath in a spiral that offsets the outer boundary by the stepover amount each time.
- Clean corners: Roughs the Engraving toolpath in a similar method to parallel spiral, but adds small cleanout moves in the corners to remove more stock.
First rough, then finish
Enabled when Rough is selected. Select to rough pockets before cutting the finish passes on the pockets. Used to minimize tool changes when using one tool for pocket roughing and a different tool for pocket finishing.
Smooth contours
Use for parts that are artistic and do not require a tight tolerance. Allows Engrave to smooth the chains for appearance rather than precision.
Sorting
Select a cut order from the drop-down list. Selection order sets the cut order in the order in which the geometry was chained. Select one of the following:
- Left to right or Top to bottom: Overrides the chaining order as the cut order.
- Selection order: Keeps the chaining order as the cut order.
Entry-ramp
Enabled when Rough is selected. Creates tool movement that slants into the pocket at a specified angle while the tool plunges. Select the checkbox to enable the Entry-ramp button and set default plunge angle (45 degrees). Choose the Entry-ramp button to open the Ramp dialog box and change or set the plunge angle.
Roughing angle
Enabled when Rough is selected. Sets the angle for the Zigzag and One Way roughing methods so that the cutting method can better match the part.
Stepover %
Enabled when Rough is selected. Sets the distance between cutting passes in the X and Y axes as a percentage of the tool diameter. Changing this value automatically adjusts the stepover distance.
Stepover distance
Enabled when Rough is selected. Measures the distance between cutting passes in the X and Y axes. This option calculates as a distance in the X and Y axes and equals the stepover percentage multiplied by the tool diameter.
Tolerance
Adjusts the level of precision of the toolpath. A tighter tolerance (smaller value) produces more NC code. A looser tolerance (bigger value) is appropriate for creating a roughing operation to be followed by a remachining operation.
At depth
Determines whether Engraving projects the geometry on top of the stock or at the toolpath depth. Projects the geometry to the Z value of the toolpath depth specified in the Engraving parameters tab. The toolpath may extend beyond the geometry's boundaries.
On top
Determines whether Engraving projects the geometry on top of the stock or at the toolpath depth. Projects the geometry at the Z value of the top of stock specified in the Engraving parameters tab. The toolpath may not reach the final depth because doing so would extend the toolpath beyond the geometry's boundaries.
Interior Corners
Sets the engraving tool to enter the toolpath at an interior corner of the toolpath. The tool enters at the interior corner closest to the point you clicked during chaining. If you want to choose a different interior corner, you can re-chain and regenerate the toolpath.
Chain start point
Sets the engraving tool to enter the toolpath at the start point of your chain.
Midpoint longest line
Sets the engraving tool to enter the toolpath at the midpoint of the longest line in the chain. If there are multiple lines of the same "longest length", the tool enters at the midpoint of the longest line that occurs first in the chaining direction, after the point that you clicked to chain the toolpath. If that first line is not the line that you want to use, you can either break that line, or change the direction of the chain. In either case, you will need to regenerate the toolpath.





