Setup: Mill-Turn 2D/3D

Use this page to define the setup for a mill operation in Mill-Turn. This includes choosing a setup type, tool plane, axis combination, spindle origin, and work offset value.

Mastercam supports the following setup types.

The "Mill Type" group on the "Setup" page of a Mill-Turn milling operation.

NOTE

Only available options, based on the capabilities of the machine and the selected geometry, will display.

See the application guide associated with your .machine file for specific information about how these options are implemented for your machine.

  • C-Axis Face: Select to enable polar interpolation for operations where the tool axis is parallel to the rotary axis. This option is useful for occasions where you wish to mill the face of your part.

    For many controls, this setup type lets you choose between longhand or cycle output. For example, on a Fanuc control this might be a G12.1 or similar command.

  • Axis Substitution: Select to enable cylindrical interpolation for operations where the tool axis is perpendicular to the rotary axis. This option is useful for occasions where you wish to mill around the outside diameter of your part.

    For many controls, this setup type lets you choose between longhand or cycle output. For example, on a Fanuc control this might be a G7.1 or similar command.

    NOTE

    Mill-Turn toolpaths that use Axis Substitution cannot be transformed.

  • Multiaxis: Select to create a multiaxis drill operation (4-axis or 5-axis output). You can also choose any of the other setup types to create a 3-axis drill operation.

    This setup type enables the Tool Axis Control page and the Safety Zone page.

  • Y-Axis Face: Select to enable Y-axis machining for operations where the tool axis is parallel to the rotary axis.

  • Y-Axis Cross: Select to enable Y-axis machining for operations where the tool axis is perpendicular to the rotary axis.

  • Plane Rotation: Select to enable coordinate conversion (tilted-plane) machining cycles. This option rotates the coordinate system plane to simplify your NC output.

    For many controls, this setup type lets you choose between longhand or cycle output. For example, on a Fanuc control this might be a G68 or similar command.

Learn more