Toolpath Hole Definition
Use the Toolpath Hole Definition function panel to select holes for a hole-making toolpath. Mastercam provides many techniques for selecting entities; use any that are appropriate for your application. Entity types that can be selected include the following:
- Points
- Arcs
- Lines
- AutoCursor positions
- Solid features (lines, arcs, and/or points)
The Features list displays more information about the selected points, by displaying the type of selection you have made and the diameter of the selected point (if applicable).
Quick Mask and AutoCursor are available for geometry selection, and you can press [D] to toggle the direction of the holes. Click OK once you have selected all of the points.
The arrow that displays when you select a solid feature or a line is normal to the entity, with the hole being cut in the opposite direction of this normal. The initial direction of the normal depends on which end of the solid feature or line you click when you select it. You can change the arrow's direction by clicking the arrow head.
- Drill patterns created without creating points in previous Mastercam versions become points created by reference in Mastercam 2023. If you remove one of these points, you need to recreate it manually before you can reselect that location.
- C-axis Drill, Face Drill, and Cross Drill toolpaths only support the selection of point and arc geometry.
-
When creating a hole-making toolpath, you can select a solid hole operation from the Solids Manager to populate the Features list in the Toolpath Hole Definition function panel and the Hole Segments page in the toolpath itself. Alternatively, use standard Mastercam selection controls to select the solid from the graphics window. You can also remove individual positions from those holes to be machined.
To reuse points from a previous toolpath:
-
Select Subprogram to select a previously created toolpath and apply the new operation to its points.
or
- Select Copy Previous Points, which creates a separate copy of the points from the previously created operation.
After you choose a reference arc, Mask on Arc selects only arcs that match the reference arc's diameter and plane. Use the Selection Bar options, such as window selection or [Ctrl+A] to select other arcs. The arcs can be either opened or closed.
If you do not want to use the default tolerance, be sure to set the Tolerance field before selecting Mask on Arc.
To change the parameters at a specific point or multiple points, select the points in the Features list and then select Change Parameters at Point. The Change Parameters at Point overlay displays in the function panel. Then you can set parameters, such as Retract and Dwell, or set the state of different coolant options. Select the white X to cancel the changes. Change Parameters at Point edits only take effect if the hole making operation is set to 3 axis.
Sort sets the order for a set of points. Each option sorts your points a different way, and one option may be better for your application. The name of the sort method indicates how it is done. For example, suppose you select X+ Y+ for a sort method. X+ indicates the direction of the advancing points; Y+ indicates the direction of the advancing rows. If you select a Zig sort method, the order of the advancing points alternate with each row. Tolerance determines if a point is in the same row, column, ring, or ray as the other points in the set or if it belongs in the next set.
The Sort methods are described below:
-
Selected Sort - Turns off point sorting and arranges your points in the order that you select or manually ordered them (using Move Up or Move Down).
-
2D Sort - Use 2D Sort when points are generally distributed in a flat plane. Points are sorted in the positive or negative X or Y direction, while advancing rows in the positive or negative X or Y direction, depending on the type of 2D Sort selected. For example, if you select X-Y+, points are sorted in the negative X direction, while advancing in the positive Y direction as shown in the following image. The red arrow indicates the Start point.
You can also select Point to Point, which, beginning at the selected start point, sorts points by advancing to the next closest point. The resulting sort order is influenced by the current sort order when multiple points are equidistant from the current.
-
Rotary Sort - Use Rotary Sort when drilling in a circular pattern. Rotary Sort sorts either rings or rays of points in a clockwise or counterclockwise direction around a center point, while advancing rings in a decreasing or increasing distance from the center point. For example, if you select Rotate Zig+ Counterclockwise, the points are sorted outward from the selected center point while advancing angles in a counterclockwise direction as shown below. The red arrow indicates the Center point.
-
Cross Sort - Use Cross Sort for drilling points wrapped around a cylinder. Cross Sort sorts rings of points in a clockwise or counterclockwise direction around a start point while advancing rings in an decreasing or increasing radius. For example, if you select Clockwise Z-, the points are sorted inward from the selected start point while advancing in a clockwise direction in the -Z direction as shown below. The red arrow indicates the Start point.





