Cut Depths
Use the Cut Depths dialog box to specify the placement of Z-axis cuts for all Rough Surface toolpaths and for Finish Contour toolpaths.
Absolute
Sets the distance between the minimum and maximum depth as an absolute distance. All cuts in the toolpath are placed between these two depths.
Incremental
Places each cut at a Z depth relative to the current surface depth. Mastercam automatically determines the minimum and maximum depths for the toolpath.
Minimum depth
Sets the highest point that the tool rises to while cutting material.
Maximum depth
Sets the lowest point that the tool descends to while cutting material. Enter a value or click Select depths to select a depth in the graphics window.
Auto-detect flats (when processing)
When enabled, Mastercam will search the part to detect flat areas where additional cuts may be added. If the drive geometry is modified or the part model changes, Mastercam re-detects the flats when the toolpath is regenerated.
Detect flats (Absolute)
Available only for Rough Contour, Rough Pocket, Rough Restmill, and Finish Contour toolpaths. Mastercam detects the part and generates a list of flat Z values which you can then edit by removing or adding other Z cuts. Mastercam may adjust the cuts above and below the flats so that cuts are placed on the flat surfaces of the part. If you add or subtract surfaces from the operation later, or if the model itself changes shape, the flats list will not be updated.
Select depths
Returns you to the graphics window to select the minimum depth, maximum depth, and any critical depths between those depths. Mastercam displays prompts in the lower left corner for the depth selection.
Clear depths
Removes any absolute or incremental depths you have selected.
Adjust for stock to leave on drive surfaces
Modifies the depth cuts to include the stock to leave for drive surfaces set on the surface parameters tab. When cleared, Mastercam ignores the stock to leave and only uses the depths you have selected.
Adjustment to top cut
Sets the distance between the minimum depth that Mastercam calculates and where the first cut of the toolpath occurs. A positive value moves this adjustment down and a negative value moves this adjustment up.
Adjustment to other cuts
Sets the distance to adjust the maximum depth that Mastercam calculates and any critical depths you specify for the toolpath. A positive value moves this adjustment up and a negative value moves this adjustment down.
Detect flats (Incremental)
Available only for Rough Contour, Rough Pocket, Rough Restmill, and Finish Contour toolpaths. Mastercam automatically finds flat areas on the surfaces so that it can place cuts at these depths to create a more optimized toolpath and improved surface finish. Cuts above and below the flats may be adjusted so that cuts are placed on the flat surfaces of the part. Detect Flats is a method for assigning critical depths for the toolpath.
Critical depths
Available only Rough Pocket, Rough Contour, Finish Contour, and Rough Restmill toolpaths. Returns you to the graphics window to select any critical depths for the toolpath. Mastercam places cuts on the surfaces you designate as critical depths and may adjust depth cuts to accommodate the critical depths.
Relative to
Measures the cut depths to the tip or center of the tool.
- For Surface Rough Project, Radial, Parallel, and Flowline toolpaths, incremental cut depths are measured from the top of the projected cut, not the top or highest point of the part model. To avoid this condition, use Absolute cut depths for these toolpaths.
- For Surface Rough Pocket, Rough Contour, Rough Restmill, and Finish Contour on parts with flat areas: Use Critical Depths and enter 0 for the Adjustment to top cut and Adjustment to other cuts parameters to avoid leaving an uneven amount of stock on the part.





