Entry Motion: Pocket
Use the Entry Motion page to add helical entry or ramp entry moves to the roughing passes for a 2D pocket toolpath. If you choose to turn Off entry motion, Mastercam plunges the tool to the pocket depth at the start of the toolpath.
| Icon | Name | Description |
|---|---|---|
|
Detect (FBM Drill) | Analyzes the solid model and detects features based on the Feature Based Machining (FBM) operation's current parameters. View the results of all detected features and their machining information in the Features page. For more information, please refer to Detection States and Modes in FBM. |
|
Reselection is not available | Hole Wizard features for a Wizard Holes operation can only be selected in Mastercam for SOLIDWORKS. Contact your Reseller for more information. |
|
Preview toolpath operations (FBM Drill/Wizard Holes) | Opens the Toolpath Operations Preview dialog box where you can view the list of operations FBM will generate using the current Features page list. |
|
Save parameters to defaults file | Makes the current toolpath settings the default for future toolpaths of this type. Saves the current values in the toolpath properties pages to the .mcam-defaults file specified in the machine group properties. |
|
Reload parameters from defaults file | Overwrites the current values in the toolpath properties pages with the toolpath's default parameters. These parameters are reloaded from the .mcam-defaults file specified in the machine group properties. |
|
Hide dialog | Minimizes the dialog box so that you can use other Mastercam functions, like changing your shading settings or the graphics window view. When finished, press [Esc] to maximize the dialog box. |
|
Tool Manager | Opens the Tool Manager. Use the Tool Manager to create and edit tool definitions and to work with tool libraries. When you close the Tool Manager, the toolpath dialog box will reappear just as you left it. |
|
Feed speed calculator | Opens the Feed & Speed Calculator dialog box where you can modify the calculated feed rate or spindle speed by adjusting the material and tool parameters. |
|
None |
Page window | This window displays all of the pages that are available to you, depending on the selected toolpath type. A green check mark indicates pages where data has changed in the current session. |
| None | Quick View Settings | This window summarizes key toolpath information from the Tool page, Coolant page, and Planes page. It updates automatically as you make changes to the different pages and is always visible. |
| None | Generate toolpath | When selected, automatically generates the toolpath when you click OK. For more information, refer to Accepting and Generating Toolpaths. |
|
OK | Generates the toolpath and closes the dialog box. If editing a toolpath, applies the changes and closes the dialog box. |
|
Apply | Applies your changes to the toolpath without closing the dialog box. |
|
Cancel | Closes the dialog box and cancels the toolpath creation. If editing a toolpath, any changes to the toolpath are discarded. |
Off
Turns off any entry moves for the roughing passes. Mastercam plunges the tool to the pocket depth at the start of the toolpath.
Ramp
Creates a ramp entry for the roughing passes. Use the other parameters on this page to set the ramp dimensions and other parameters.
Helix
Creates an entry helix for the roughing passes. Use the other parameters on this page to set the helix dimensions and other parameters.
Minimum length
Determines the smallest possible length for the entry ramp. Enter the minimum length as a percentage of the tool diameter or as an absolute distance.
Maximum length
Determines the largest possible length for the entry ramp. Enter the maximum radius as a percentage of the tool diameter or as an absolute distance.
Z clearance
Sets the Z axis distance above the current top of the stock where the entry move will begin.
XY clearance
Sets the minimum distance in the X axis and Y axis between the entry move and the finished wall.
Plunge zig angle
Determines one of the angles of descent for the entry ramp. An entry ramp with a zag angle of zero always starts with a zig angle.
Plunge zag angle
Sets the size of the last angle of the entry ramp.
Auto angle
Automatically sets the XY angle at which to generate the entry ramp. The system determines the longest area of the pocket and places the entry ramp in that area. This angle is set relative to the construction plane. If you select Auto angle, you cannot enter an XY angle.
XY angle
Sets the angle at which to generate the entry ramp. The tool zigzags into the part and then moves from the end of the ramp to the start of the toolpath. This angle is set relative to the construction plane. If you select Auto angle, you cannot enter an XY angle.
Additional slot width
Adds a fillet at the end of each ramp for a smoother tool movement. The fillet radius equals half the additional slot width. This option can be used for high speed machining.
Align ramp with entry point
Adjusts the entry ramp to coincide with the entry point in the same plane as the XY angle of the ramp.
Ramp from entry point
Ramps into the pocket toolpath from a point selected during chaining. Mastercam moves the tool at the point you select from the rapid plane down to the point depth. The tool then ramps down from this point to the pocket toolpath's start point at the pocket depth.
Minimum radius
Determines the smallest possible radius for the entry helix. Enter the minimum radius as a percentage of the tool diameter or as an absolute distance. Note that the absolute distance field is unavailable when defining FBM-generated toolpaths.
Maximum radius
Determines the largest possible radius for the entry helix. Enter the maximum radius as a percentage of the tool diameter or as an absolute distance. Note that the absolute distance field is unavailable when defining FBM-generated toolpaths.
Z clearance
Sets the Z axis distance above the current top of the stock where the entry move will begin.
XY clearance
Sets the minimum distance in the X axis and Y axis between the entry move and the finished wall.
Plunge angle
Sets the angle of descent for the entry move, and determines the pitch. A smaller plunge angle means that the entry move takes longer to descend in the Z axis. A recommended angle is 3 to 5 percent.
Tolerance
Breaks the helix entry move into linear segments within the specified tolerance. A lower tolerance value produces a more exact entry helix, but may create larger NC files and increase processing time.
This option takes effect when Output 3D arc entry motion is deselected on the Arc Filter/Tolerance page. The Output 3D arc entry motion option creates the helix with arc (G2/G3) moves. When deselected, the helix will be rendered with many small linear moves. For more information, refer to the Arc Filter/Tolerance Help topic.
| Output 3D arc entry motion selected | Output 3D arc entry motion deselected, Tolerance set to 1.0 |
|---|---|
|
|
Center on entry point
Finds the first chained point in a region and centers the entry helix on that point.
Follow boundary
Starts the pocket toolpath by following the rough boundary instead of creating an entry helix. This option uses the entry rate set at the bottom of the dialog box. Note that, if this option is on and On failure only is off, the Minimum radius, Maximum radius, and Center on entry point options are not available.
On failure only
Starts the pocket toolpath by following the rough boundary if the entry helix fails. The helix fails when the system cannot create a helix between the minimum radius and the maximum radius. Only available if you select the Follow boundary option.
If length exceeds
Defines when the Follow boundary option fails. If the rough boundary determined by the system is shorter than the minimum boundary length, failure occurs. Only available if you select the Follow boundary option.
CW (Clockwise)
Sets the cut direction to clockwise.
CCW (Counterclockwise)
Sets the cut direction to counterclockwise.
If all entry attempts fail
Select one of the following.
-
Plunge: Plunges directly into the part at the start point of the pocket toolpath if the system cannot calculate the entry move or a rough boundary.
-
Skip: Disregards the current pocket and moves to the next chained region or pocket in the toolpath if the system cannot calculate the entry move or a rough boundary.
Save skipped boundary
Saves the skipped pocketing boundary as part of the geometry if the system cannot calculate either the programmed entry move or a rough boundary. You must still save the geometry to preserve both the geometry and its boundary. Only available if you select Skip.
Plunge rate
Uses the tool's plunge rate for the entry helix/ramp.
Feed rate
Uses the tool's feed rate for the entry helix/ramp. If it does not fit, the plunge rate is automatically used for the plunge entry.
If the programmed entry move does not fit and you select the Follow boundary option, the plunge rate or the feed rate (whichever you select) is used for the boundary. If both entry methods fail, the plunge rate is automatically used for the plunge entry.





