FBM Mill Tools
Use this page to
manage tool selection for the finish operations FBM Mill creates.
In the large window, use right-click menu options to select up
to 10 preferred tools for the operation type.
Mastercam uses the selected tools only when Preferred tooling is enabled in the
Setup page, as shown in
the following picture.
The Automatic tool selection
parameters in the tools pages apply to some or all of the following
types of tools.
- Tools in the part file
- Tools in the selected library
- Tools created by Mastercam for the
operation
- Tools used to fillet internal feature
edges in the X and Y axes.
NOTE
You can save the default list
of preferred tools and other FBM Mill parameters in the operations
.mcam-defaults file. Click Save
parameters to defaults file located at the top of
this dialog box.
Parameters
NOTE
Not all options are available for all tool pages.
Common Toolpath Parameter Controls
Preferred tool list
Use right-click menu options to add up to 10 tools to the list of preferred tools
for the operation type. Tool types supported for preferred tooling are Flat, Bull, Ball, Face. When Preferred tooling is activated in the Setup page, Mastercam searches your preferred
tools list from the largest to smallest tool to find an appropriate tool for each
FBM-generated toolpath. The search ends with the first tool small enough to machine
the feature (even if a more appropriate tool is available in another selected source).
No operation is created if Preferred tooling is active but the preferred tool list
is empty.
Automatic tool selection
Applies only when tool selection options Use tool library or Create as needed are
selected in the Setup page. Use these fields to control how Mastercam selects tools from the specified library,
or creates them.
Maximum diameter
Enter the maximum tool diameter for automatic tool library selection or tool creation.
FBM will not select or create tools larger than this diameter.
Tool size increments based on maximum diameter
Defines the size gap between tools that Mastercam uses to find or create the next
available tool size. The Value and % reduction fields are associative and are based
on the Maximum diameter defined for automatic tool selection. Entering a value in
one automatically updates the other. A value of 25% means that the next tool selected
or created will be 25% smaller than the previous one, starting with the maximum diameter
tool. If you specify a small tool increment, Mastercam selects or creates more tools between
the automatic tool selection's maximum and minimum diameters. Larger tool increments result in fewer tools selected or created.
Minimum diameter
Enter the minimum tool diameter for automatic tool library selection or tool creation.
FBM will not select or create tools smaller than this diameter.
Internal XY fillets
Choose a strategy for selecting or creating tools to machine internal fillets in
the XY axes. This strategy applies only when the minimum tool diameter is less than
or equal to the fillet. Choose one of the following options:
- Match tool with arc: When selecting or creating the tool, Mastercam uses the fillet
size plus the stock to leave value you defined in the Floor finish and Wall finish
cut parameters pages.
- Use next smaller tool: Choose a tool that is the next size smaller based on your
automatic tool selection settings (preferred tools, part file, library, or create as needed).
If Mastercam must create the tool, it creates the next smaller standard size for
the tool type.
- % of arc size: Selects or creates a tool no larger than the percentage of the arc
you specify.
Match wall draft with tapered tool
Selects a tapered tool that matches the draft on the part wall. Disables the Tapered
wall stepdown field on the Wall finish page. The depth cuts values on the Wall finish
page are used for the toolpath.
Allow use of
Select the tool type Mastercam should choose or create for the operation type. The
tool type you choose applies when searching for tools in the Mastercam file or the selected
tool library, and when creating tools, provided that these options are activated
in the Setup page. Note that in the Facing tools page, Ball tool is unavailable; it is replaced with Face
mills. Face mills are available only in the Facing tools page.
Right-click menu options
Create new
tool
Opens the Tool Wizard where you create the new tool.
Edit tool
Opens the selected tool definition for editing in the
Tool Wizard.
Delete tool
Removes the tool from the FBM tool list for the selected
toolpath type.
Select tool
from part
Opens the Tool
Selection dialog box which lists only the tools that
are currently saved in the Mastercam part file.
Select
tool from library
Opens the Tool Selection dialog
box where you can select a tool from the current tool
library, or from any tool library you choose.
Duplicate
tool
Quickly creates a new tool using one that
is already in the list. Select a tool in the list then
use this option to open the Tool Wizard. All values from the selected tool
display and can be edited before saving the new tool.