Features: FBM Drill/Wizard Holes
Use this page to
manage the list of hole features that the FBM drilling operation
detects in the solid model. The holes and machining information
in the list are based on the parameters you set in the operation's
other pages.
For each hole listed, you can use right-click
menu options to change the hole type, tool plane, and finish tool.
You can also delete holes from the list (select and press [Delete]), or use the right-click
Suppress option to exclude
them from the operation.
When you accept the operation, Mastercam creates
drill cycles for all holes in the Features list that can be machined.
Make
these modifications only at the final stage of creating the FBM
drill operation. Detect rebuilds the Features page list, overwriting any hole type, plane, and finish tool modifications.
NOTE
- The Features page settings are saved
within the part file after choosing OK.
The saved settings—including
assigned hole types, finish tools, suppressed states, and
planes—are
applied to existing features even if Detect
is selected again.
- Imported
SOLIDWORKS®
data is the exception to this rule. On redetect, Mastercam
replaces all imported SOLIDWORKS Hole Wizard® data with feature
data detected in the Mastercam part file.
- To delete all
saved data and regenerate new data for the FBM Drill operation,
activate the Delete existing
features on detect checkbox in the Hole
Detection page, and then detect features.
- Different options display when you
right-click in the Hole type,
Plane, and Finish
tool columns.
- The Z1
column displays the depth where the hole feature starts. For
co-axial features, the Z1 value is also the bottom (end) of
the feature that is positioned immediately above the next
co-axial feature. The Depth column
shows the distance between Z1
and the designed bottom of the hole.
-
Hole information is not
listed until you click Detect, located at the top of the dialog box. Choose
Detect whenever
you make changes to FBM Drill parameters. Then view
results in the Features page carefully before saving
the operation.
- Use [Shift+click]
and [Ctrl+click]
methods to select more than one hole in the list.
-
Features
with this status indicate that Mastercam cannot completely
machine them using the current tool selection and
FBM drilling parameters.
-
If
you are working with an imported SOLIDWORKS part,
and you have SOLIDWORKS installed on your local PC,
click Select SOLIDWORKS
file to open the model's .sldprt file
and update the features list with imported SOLIDWORKS
Hole Wizard data.
Parameters
Common Toolpath Parameter Controls
Display all normals
Select to display normal direction arrows in the graphics window for all detected holes. Deselect to remove the arrows from the display.
To set the normals of all detected holes to the same normal, right-click anywhere in the features list, and choose Select normal point from the right-click menu. Then choose a point in the graphics window.
You can set the normals of all detected features in a direction towards the current tool plane, if this is possible. To do this, select Set normals toward tool plane on detect in the Hole detection page. Then choose Detect to make the change. (FBM Drill only)
Hole type column
Use to change the hole type currently assigned to features. First select one or more features to change. Then right-click in the column, choose Hole type, and select a new hole type from the list.
Plane column
Use to change the tool plane currently assigned to features. First select one or more features to change. Then right-click in the column, choose Plane, and select a new plane from the list.
The list displays only valid machining planes for the selected features (perpendicular planes are omitted from the list). If you choose holes from non-parallel planes, such as Top and Left planes, only planes that are parallel to the first hole in the list can be changed. If you select a Top plane hole feature along with holes in Left and Bottom planes, Mastercam changes only the Top and Bottom planes. Selecting a [reverse plane] option will reverse all selected holes regardless of initial plane.
Z1 column
The Z1 column displays the depth where the hole feature starts. For coaxial features, the Z1 value is also the bottom (end) of the feature that is positioned immediately above the next coaxial feature.
Depth column
The Depth column shows the distance between the Z1 depth and the designed bottom of the hole.
Finish tool column
Use to change the hole feature's finish tool. First select one or more features to change. Then right-click in the column, choose Finish tool, and select a new tool from the list. The three-character prefix in the finish tool list indicates that the tool is from one of the following tool sources:
- MCAM: Mastercam part file
- LIB: Selected tool library
- XLS: Created for the operation using FBM's standard tool definitions file. FBM uses the tool definitions in this file to create new tools if your automatic tool selection settings on the Tools page include Create as needed. It is used exclusively if Create only standard sizes is also selected on that page.
Select (FBM)
Click to return to the graphics window and select one or more features in the solid model. When you end selection, these features are also selected in the Features page list.
Select / Unselect all (FBM)
Click to select or unselect all features in the list.
Select common features
Select to activate the option to select all holes in the Feature list with common attributes. Then click Select common features to access the Feature Selection dialog box where you can choose the attributes to match in the list.
Select co-axial features
When activated, automatically selects all co-axial hole features in the list (co-axial holes are multiple holes that share a common axis).
Select SOLIDWORKS file
Available only if the current workstation includes a valid SOLIDWORKS installation. Allows FBM Drill to utilize the SOLIDWORKS Hole Wizard data when generating operations for detected features. Click this button to select the SOLIDWORKS part file that corresponds to the current solid model and import its Hole Wizard data into the features list. During the import, Mastercam matches the SOLIDWORKS Hole Wizard data to features in the list by comparing hole diameter, coordinates, and plane information. For each match, if the information in the features list is different, Mastercam redefines it using the SOLIDWORKS Hole Wizard definition.
Right-click menu options
- Hole type: Available only in the Hole type column. Use to change
the hole type currently assigned to one or more selected
features.
- Suppress: Removes
toolpaths for suppressed features from those generated
by the FBM Drill-operation. However, when FBM Drill generates
toolpaths for unsuppressed features, it considers suppressed
feature data when calculating incremental clearance and
retract moves.
- Selected: Suppress the holes selected
- Previously
machined:
Suppress previously machined features
- Features
with warnings: Suppress all features with warnings
- Plane: Available only in the Plane column. Use to change the
plane currently assigned to one or more selected features.
The list displays only valid machining planes for the
selected features (perpendicular planes are omitted from
the list). If you choose holes from non-parallel planes,
such as Top and Left planes, only planes that are parallel
to the first hole in the list can be changed. If you select
a Top plane hole feature along with holes in Left and
Bottom planes, Mastercam changes only the Top and Bottom
planes. Selecting a [reverse plane] option will reverse
all selected holes regardless of initial plane.
- Finish tool: Available only in the Finish tool column. Use to change
the tool currently assigned to one or more selected features.
The three-character prefix in the finish tool list indicates
that the tool is from one of the following tool sources:
- MCAM: Mastercam part file
- LIB: Selected tool library
- XLS: Created for the operation using FBM's standard tool definitions file. FBM uses the tool definitions in this file to create new tools if your automatic tool selection settings on the Tools page include Create as needed. It is used exclusively if Create only standard sizes is also selected on that page.
- Set
normal direction:
- Delete: Deletes the selected holes from the list. To restore deleted
holes, run Detect
again.
- Summary: Opens the Feature
Summary dialog box where you view a summarized list
of all detected features grouped by common hole types,
diameters, and finish tools.