Linking Parameters page: FBM Drill/Wizard Holes
Use the Linking Parameters page to define how FBM Drill and Wizard Holes calculate clearance height and retract height for the drilling cycles.
| Icon | Name | Description |
|---|---|---|
|
Detect (FBM Drill) | Analyzes the solid model and detects features based on the Feature Based Machining (FBM) operation's current parameters. View the results of all detected features and their machining information in the Features page. For more information, please refer to Detection States and Modes in FBM. |
|
Reselection is not available | Hole Wizard features for a Wizard Holes operation can only be selected in Mastercam for SOLIDWORKS. Contact your Reseller for more information. |
|
Preview toolpath operations (FBM Drill/Wizard Holes) | Opens the Toolpath Operations Preview dialog box where you can view the list of operations FBM will generate using the current Features page list. |
|
Save parameters to defaults file | Makes the current toolpath settings the default for future toolpaths of this type. Saves the current values in the toolpath properties pages to the .mcam-defaults file specified in the machine group properties. |
|
Reload parameters from defaults file | Overwrites the current values in the toolpath properties pages with the toolpath's default parameters. These parameters are reloaded from the .mcam-defaults file specified in the machine group properties. |
|
Hide dialog | Minimizes the dialog box so that you can use other Mastercam functions, like changing your shading settings or the graphics window view. When finished, press [Esc] to maximize the dialog box. |
|
Tool Manager | Opens the Tool Manager. Use the Tool Manager to create and edit tool definitions and to work with tool libraries. When you close the Tool Manager, the toolpath dialog box will reappear just as you left it. |
|
Feed speed calculator | Opens the Feed & Speed Calculator dialog box where you can modify the calculated feed rate or spindle speed by adjusting the material and tool parameters. |
|
None |
Page window | This window displays all of the pages that are available to you, depending on the selected toolpath type. A green check mark indicates pages where data has changed in the current session. |
| None | Quick View Settings | This window summarizes key toolpath information from the Tool page, Coolant page, and Planes page. It updates automatically as you make changes to the different pages and is always visible. |
| None | Generate toolpath | When selected, automatically generates the toolpath when you click OK. For more information, refer to Accepting and Generating Toolpaths. |
|
OK | Generates the toolpath and closes the dialog box. If editing a toolpath, applies the changes and closes the dialog box. |
|
Apply | Applies your changes to the toolpath without closing the dialog box. |
|
Cancel | Closes the dialog box and cancels the toolpath creation. If editing a toolpath, any changes to the toolpath are discarded. |
Clearance
Clearance is the height at which the tool moves to and from the part. Use these fields to define how Mastercam calculates the clearance height.
- Solid height plus: Adds a fixed height above the highest point of the solid model. When you choose this option, Mastercam sets clearance height to Incremental. Use the data entry field to add an additional clearance distance to the solid model height. Entering 0.0 in this field sets clearance to the same height as the highest point of the solid model.
- Stock model plus: Adds a specified height above the stock model (defined in machine group properties) and sets clearance height to Incremental. Use the data entry field to add an additional clearance distance to the stock model height. Entering 0.0 in this field sets clearance to the same height as the stock model.
- Top of hole plus: Adds a clearance distance above the top of each hole. When you choose this option, Mastercam sets clearance height to incremental. Use the data entry field to add an additional clearance distance to the top of each hole. Entering 0.0 in this field sets clearance to the same height as the top of the hole.
- Top of coaxial holes plus: For holes that share the same axis, sets the clearance height above the highest hole on the shared axis, highest being relative to the tool plane and machining direction. When you choose this option Mastercam automatically sets clearance height to Incremental. Use the data entry field to add an additional clearance distance to the top of the highest coaxial hole. Entering 0.0 in this field sets clearance to the same height as the top of the highest coaxial hole.
- Manual: Allows you to set clearance using all options in any combination (Clearancebutton and entry field, and Absolute/ Incremental). Click the button to set the clearance value by choosing a point in the graphics window.
Use clearance only at the start and end of operation
Rapids to the clearance plane only at the start and end of the toolpath.
Retract
Use these fields to define the height to which the tool moves before the next tool pass in the FBM-generated drill cycles.
- Solid height plus: Sets the retract to a specified height above the highest point of the solid model. When you choose this option, Mastercam sets the retract height to Incremental. Use the data entry field to add a retract distance to the solid model height. Entering 0.0 in this field sets the retract to the same height as the highest point of the solid model.
- Stock model plus: Sets the retract to a specified height above the stock model (defined in machine group properties) and sets the retract height to Incremental. Use the data entry field to add a retract distance to the stock model height. Entering 0.0 in this field sets the retract to the same height as the stock model.
- Top of hole plus: Adds a retract distance above the top of each hole. When you choose this option, Mastercam sets the retract height to Incremental. Use the data entry field to add an additional the retract distance to the top of each hole. Entering 0.0 in this field sets the retract to the same height as the top of the hole.
- Top of coaxial holes plus: For holes that share the same axis, sets the retract height above the highest hole on the shared axis; highest being relative to the tool plane and machining direction. When you choose this option, Mastercam sets the retract height to Incremental. Use the data entry field to add an additional retract distance to the top of the highest coaxial hole. Entering 0.0 in this field sets the retract to the same height as the top of the highest coaxial hole.
- Manual: Allows you to set the retract height using all options in any combination (Retract button, entry field, Absolute/ Incremental). Click the button to set the retract height by choosing a point in the graphics window.
Tap/Ream adjustment
Determines whether tapped and reamed holes are fully finished in the FBM-generated drill cycles.
Avoid tool bottoming out by
-
Adjust tap / ream up: Modifies the tap/ream drill cycle. Mastercam does not plunge the tap/ream tool to the bottom of the hole by the specified Distance/% of tool diameter. Choose this option when the hole should be machined at the specified depth, but the tool should not finish the hole all the way to the bottom.
-
Adjust pre-drill down: Modifies the pre-drill cycle for tapped/reamed holes. Mastercam pre-drills the hole deeper than its designed depth by the specified Distance/% of tool diameter. This allows the subsequent tap / ream drill cycle to fully finish the hole, achieving full cutter depth without bottoming out. Choose this option when the effective cut depth is equal to the designed hole depth.
-
No adjustment: Deactivates the Distance/% of tool diameter fields. Mastercam plunges the tool to the defined hole depth.
Tip compensation (Through holes and Blind holes)
Use the checkboxes to independently turn tip compensation on or off for through holes or blind holes. If tip compensation is on, Mastercam includes the tool tip in the final plunge depth. If tip compensation is off, Mastercam sets the final plunge depth to the apex of the tool tip.
Additional break through
Select to extend the tip-compensated plunge depth for through holes and blind holes by a specified distance or by a percentage of the tool's diameter. Choose one of the following:
- Distance: Adds a fixed distance.
- % of tool diameter: Calculates the distance to add as a percentage of the tool's diameter.





