Reference Tool Diameter for Pencil Toolpaths

When creating a high speed pencil toolpath, it is important to know the size of the machining area so that you can make sure that you are in fact machining all of the areas that were missed by the roughing tool. Mastercam calculates a special parameter called the Reference tool diameter that can help guide you.

This setting is available on the Cut Parameters page for pencil toolpaths when you specify multiple offsets. When you create several cuts, the area that is machined is a function of several parameters:

  • The finish tool size
  • The number of cutting passes
  • The stepover between passes

Based on the values that you enter for these parameters, Mastercam calculates the Reference tool diameter. This is the size of the theoretical roughing tool that would have machined the cutting zone defined for the pencil toolpath. In other words, if the Reference tool diameter is greater than the actual tool you used for your roughing operation, you can be confident that the pencil toolpath will reach all of the areas that could not be roughed.

The picture below shows you how this value is calculated. If this value is smaller than your actual roughing tool, consider increasing the number of passes until it is larger. You could also increase the stepover, or select a larger finishing tool.

A tool with labeled inputs for the "Reference tool diameter" calculation.

  1. Finish tool radius
  2. Stepover
  3. # of offsets
  4. Reference tool radius

If you manually override the calculated Reference tool diameter with a different value, Mastercam will adjust the number of offsets to the proper number. In other words, if you know how wide your machining zone needs to be, you can enter that value directly in the Reference tool diameter field and Mastercam will automatically calculate the proper number of cutting passes. Once you manually override the calculated value, Mastercam will not automatically change it again.

This distance is measured from each side of the surface boundaries. In other words, if the Reference tool diameter is 20mm, the machining zone will be 40mm wide with the surface boundary in the middle.

Learn more