Rough Parameters: Surface Rough Pocket
Use the Rough parameters tab to set parameters for a Surface Rough Pocket toolpath.
Total tolerance
Displays the sum of the Cut tolerance, the Line/arc tolerance, and Smoothing tolerance. Click Total tolerance to open the Arc Filter/Tolerance dialog box. Use the options in this dialog box to set parameters for filtering and smoothing toolpath motion within the specified total toolpath tolerance.
Maximum stepdown
Sets the distance between adjacent cuts in the Z axis.
Detect undercuts
Enables undercutting which allows the toolpath to machine under features of the part. When deselected, undercutting is disabled and the toolpath will avoid undercut regions of the part.
This option is only enabled when an undercut tool, such as a dove mill or slot mill, is selected. This option is unavailable if you selected a convex tool, such as a ball end mill or face mill.
Machining direction
Sets the machining direction of the toolpath. Select one of the following:
- Climb: Cuts in one direction with the tool rotating in the opposite direction of the tool motion.
- Conventional: Cuts in one direction with the tool rotating in the same direction as the tool motion.
Entry - Helix
Select to add a helical entry move to the toolpath. Click Entry - Helix to open the Helix/Ramp Parameters dialog box to set parameters.
Use entry point
Select to start the toolpath at the selected Entry point. If you do not select an entry point when selecting the drive geometry for the toolpath and you enable this parameter, Mastercam will prompt you to select the entry point when generating the toolpath.
Plunge outside containment boundary
Select to search for an entry point outside of the tool containment boundary.
Align plunge entities for start holes
Select to create each plunge entry in the same place so that the start holes can be used to create arcs and drill cycles at the plunge points in the operation.
Facing
Select to automatically detect and create motion on the flat surfaces within a pocket. Click Facing to open the Facing parameters dialog box to set parameters.
Cut depths
Sets the minimum and maximum depths either as absolute depths or relative to the top and bottom of the part. Additionally, sets depth cuts on flat surfaces and critical depths. Click Cut depths to open the Cut Depths dialog box.
Gap settings
Sets the handling of motion when there is a break in the tool motion, such as between two surfaces. Click Gap settings to open the Gap Settings dialog box.
Advanced settings
Sets tool roll motion at sharp corners between surfaces and at the extreme edges of the part, the corner tolerance, and performs checks on solid and surface models. Click Advanced settings to open the Advanced settings dialog box.





