Rough Project Parameters
Use this tab to project curves, points, or another toolpath (NCI file) onto surfaces or solids. Rough Project can clean out cavities using a pocketing motion generated by a standard pocket and then projected onto the surfaces that make up the cavity. It can also be used to engrave letters or other curves. Projecting points onto surfaces can create plunging motion to clear small areas in detailed parts.
Total tolerance
Displays the sum of the Cut tolerance, the Line/arc tolerance, and Smoothing tolerance. Click Total tolerance to open the Arc Filter/Tolerance dialog box. Use the options in this dialog box to set parameters for filtering and smoothing toolpath motion within the specified total toolpath tolerance.
Maximum stepdown
Sets the distance between adjacent cuts in the Z axis.
Projection type
Sets what you are projecting. Choose one of the following:
- NCI: Projects an NCI file onto the selected entities.
- Curves: Projects a curve or set of curves onto the selected entities. Prompts you to select the curves after you enter the toolpath parameters.
- Points: Projects a point or a set of points onto the selected entities. Prompts you to select the points after you enter the toolpath parameters.
Retract between cuts
Forces a retract move between cuts. When deselected, the tool stays down between cuts. When projecting letters onto a surface or solid, such as when engraving, the Retract between cuts option lifts the tool between the letters.
Plunge control
Sets how the toolpath plunges into the part:
- Allow multiple plunges along cut: Makes multiple entry moves along a part.
- Cut from one side: Begins cutting on the starting side of the part, plunges and retracts in cut, but does not plunge back into the same cut after a rapid move to a new cutting position.
- Cut from both sides: Allows plunging and cutting from opposite sides. After a retract, allows a plunge move along the same cut.
Allow negative Z motion along surface
Lets the tool cut along the surface while plunging. Deselect this option if you are using a tool that does not cut downward.
Allow positive Z motion along surface
Lets the tool cut along the surface while retracting. Deselect this option if you are using a tool that does not cut upward.
Source operations
Select an operation from the list. The operation is then used as the selected source operation.
Cut depths
Sets the minimum and maximum depths either as absolute depths or relative to the top and bottom of the part. Additionally, sets depth cuts on flat surfaces and critical depths. Click Cut depths to open the Cut Depths dialog box.
Gap settings
Sets the handling of motion when there is a break in the tool motion, such as between two surfaces. Click Gap settings to open the Gap Settings dialog box.
Advanced settings
Sets tool roll motion at sharp corners between surfaces and at the extreme edges of the part, the corner tolerance, and performs checks on solid and surface models. Click Advanced settings to open the Advanced settings dialog box.





