Roughing: Circle Mill
Select Roughing to activate
the circle mill roughing feature. It provides high-speed pocket-style
cleanout for the circle geometry
with motion similar to the Spiral pocket style. This style creates
roughing passes using tangent arcs. The result provides a smooth
motion for the tool, a short NC program, and good
If you select Helical entry,
Mastercam creates the roughing motion tangent to the helical entry.
If you are also creating depth cuts, the high-speed roughing features
are repeated at each depth.
Both the direction for the helical entry and the machining direction
for the roughing motion are determined by the compensation settings
for the toolpath defined in the Cut
parameters page.
NOTE
- If you use these roughing options,
you may not need to use the Semi-finish
section of the Finishing
page, which provides more contour-style roughing motion.
- For movement between the roughing
and finishing sections to be tangent, set the Entry/exit
arc sweep parameter on the Transitions
page to 180 degrees.
Parameters
Common Toolpath Parameter Controls
Stepover percentage
Sets the distance between cutting passes in the X and Y axes as a percentage of the
tool diameter. Changing this value automatically adjusts the stepover distance.
Stepover distance
Measures the distance between cutting passes in the X and Y axes. This option calculates
as a distance in the X and Y axes and equals the stepover percentage multiplied by
the tool diameter.
Helix entry
Select to create an entry helix for the pocket toolpath's roughing passes. Then use
the other fields on the page to set the helix dimensions and other parameters.
Minimum radius
Determines the smallest possible radius for the entry helix. Enter the minimum radius
as a percentage of the tool diameter or as an absolute distance.
Note that the absolute distance field is unavailable when defining FBM-generated toolpaths.
Maximum radius
Determines the largest possible radius for the entry helix. Enter the maximum radius
as a percentage of the tool diameter or as an absolute distance.
Note that the absolute distance field is unavailable when defining FBM-generated toolpaths.
XY clearance
Sets the minimum distance in the X axis and Y axis between the entry move and the
finished wall.
Z clearance
Sets the Z axis distance above the current top of the stock where the entry move
will begin.
Plunge angle
Sets the angle of descent for the entry move, and determines the pitch. A smaller
plunge angle means that the entry move takes longer to descend in the Z axis. A recommended
angle is 3 to 5 percent.
Plunge
Plunges directly into the part at the start point of the pocket toolpath if the system
cannot calculate the entry move or a rough boundary.
Skip
Disregards the current pocket and moves to the next chained region or pocket in the
toolpath if the system cannot calculate the entry move or a rough boundary.