Ruled Parameters
Use this tab to enter the toolpath parameters for a ruled wireframe toolpath. This toolpath simulates a ruled surface over several chains of geometry.
- First, select a cutting method. This determines the pattern that the tool will follow over the part surface. The 5-axis SWARF cutting method works only if 5-axis tool motion is supported in the current machine definition.
- Enter other toolpath dimensions and compensation options.
- Finally, select the trimming options. You can define up to two trimming planes for the toolpath. Each trimming plane consists of a value along one of the coordinate axes. If the toolpath would extend past the trim plane, it is clipped; if the trim plane is outside the toolpath, the toolpath is extended to it.
Zigzag
Forces the tool to stay down on the surface at all times and move back and forth across the part.
One way
Takes a pass, rapids up to the rapid depth, moves back to the beginning of the cut, and takes another pass in the same direction. All passes are in the same direction.
Circular
Produces a spiral toolpath. Normally used only in conjunction with constant Z cutting. Circular should be used only when all boundaries are closed.
5 axis swarf
Used for 5-axis (side) cutting. You can add entry and exit curves to a ruled 5-axis Swarf toolpath using the Entry/exit option on the Multiaxis, Linking page.
Angle
Tilts the ruled 5-axis toolpath for tapered cutters. Only available if you select the 5-axis swarf cutting method.
Across cut distance
Sets the distance between cuts in the across direction. Stepover is applied to the longest along boundary. This parameter determines surface smoothness. A smaller increment takes longer to process, but works well for more extreme surface curvatures. The more drastic the curvature on the part, the smaller the step size should be. On a fairly flat surface, a larger cutting distance may be used (for example, 0.150).
Stock to leave
Enter the amount of material to leave on the part model when the operation is finished.
Rapid depth (abs)
Sets the height from which the tool plunges at the rapid speed before it machines the part at the feed rate. The tool also retracts to this height when moving between toolpath segments. This parameter is an absolute value.
Compensation in computer
Generates a toolpath with compensation for the tool radius, but does not allow for tool wear adjustment at the control. Left and Right offset the tool by its radius; Off causes the tool to cut the center line of the geometry.
Tip compensation
Sets amount of offset to the tool's center or tip for bull-nose and ball (spherical) tools. Used for touching the tool off the part. For multiaxis toolpaths, Tip compensation outputs the tool tip offset as either the tip or the corner radius distance from the tip.
Sync option
Lines up the across and along boundaries. Selecting Manual or Manual/density requires additional data input.
Trimming plane X-Y-Z
Prevents the tool from cutting past the specified coordinate. Select the plane in which you want the toolpath to be trimmed, and enter a coordinate value in the Value field. The toolpath trims to the trimming plane but the actual surface remains unchanged.
Trimming plane: None
Turns off the selected trimming plane.
Trim the tool
Prevents the tool from passing through the trimming planes. Only available if the trimming planes are turned on.
Trim the toolpath
Prevents the toolpath from passing beyond the trimming planes. Only available if the trimming planes are turned on.
Off (Constant Z cutting)
Allows the tool to change Z depth during each cut. Select this option when you set the cutting method to 5 Axis.
On (Constant Z cutting)
Keeps the tool at a constant Z depth for each cut. Cuts are relative to the current tool plane (if you define a tool plane) or the XY plane (if you do not define a tool plane). The system ignores the Gouge check setting if you enable Constant Z cutting.
Initial
Sets the Z depth of the initial cut. Only available if you turn constant Z cutting on.
Final
Sets the Z depth of the final cut. Only available if you turn constant Z cutting on.
Step
Sets the Z depth between each cut. Only available if you turn constant Z cutting on.
Off (Gouge check)
Disables gouge checking.
Perpendicular to machining
Applies the gouge checking function to the across direction. If the system detects a gouge, it attempts to eliminate it.





