Steep/Shallow page
Use the Steep/Shallow page to limit how much of your drive surfaces will be machined. Typically these options are used to create machining passes in steep or shallow areas, but they can be useful for many different part shapes. You can find the Steep/Shallow page in the 3D High Speed Toolpaths dialog box for many 3D toolpaths.
Common Toolpath Parameter Controls
Not all options are available for all toolpaths.
From
Use this field to limit the machining zone by the angle of the surface relative to the tool plane. Enter the angle of the shallowest area that you want to cut.
To
Use this field to limit the machining zone by the angle of the surface relative to the tool plane. Enter the angle of the steepest area that you want to cut.
Use boundaries as drive curves, then collapse
For most applications, this option should be turned on. It typically results in much smoother, more natural tool motion around drive surface boundaries.
Smoothing tolerance
Equal Scallop only. Smooths the internally calculated steep/shallow boundary.
This option is not the same as the Projected boundary smoothing tolerance, which smooths the selected Boundary chains on the Toolpath Control page.
Detect limits
Click to have Mastercam automatically populate Minimum depth and Maximum depth with the highest and lowest points on your drive surfaces.
Minimum depth
Enter the Z value of the highest point on your part that you want to cut. To select a point from the graphics window, click the arrow to the right of the field. Use the checkbox to enable or disable Minimum depth and its suboptions.
Maximum depth
Enter the Z value of the lowest (deepest) point on your part that you want to cut. To select a point from the graphics window, click the arrow to the right of the field. Use the checkbox to enable or disable Maximum depth and its suboptions.
Automatically detect depth
Mastercam automatically detects the Z limits when the toolpath is processed.
Include stock
When manually or automatically detecting the minimum or maximum Z limit, Mastercam includes the stock model defined on the Stock page in addition to the geometry defined on the Model Geometry page .
Adjust for stock to leave
When selected, Mastercam will adjust the toolpath based on the values entered in the Floor stock column for Machining geometry in the Model Geometry page by the following:
- All positive values, Mastercam will use the largest (most positive) value to adjust both Minimum depth and Maximum depth.
- All negative values, Mastercam will use the largest (most negative) value to adjust both Minimum depth and Maximum depth.
- Both positive and negative values, Mastercam will use the largest (most positive Z value) to adjust the Minimum depth and the largest (most negative Z value) to adjust the Maximum depth.
Contact
Select Flute contact to force Mastercam to create cutting passes only where the tool is actually in contact with a drive surface. This can eliminate circumstances where Mastercam might otherwise create cutting passes through air. Select Tool assembly contact to only output motion in contact with drive data. This should eliminate the air cuts along containment boundaries.
Follow containment
Waterline only. Allows the tool to follow the containment boundary back to the start of the cut, creating closed passes. This also helps to avoid partial cuts when a containment boundary was directly on top of a vertical surface.





