Roughing: Advanced
Use the Advanced subpage of the Roughing page to specify advanced options for fine-tuning your roughing passes.
Not all options are available for all toolpaths.
| Icon | Name | Description |
|---|---|---|
|
Detect (FBM Drill) | Analyzes the solid model and detects features based on the Feature Based Machining (FBM) operation's current parameters. View the results of all detected features and their machining information in the Features page. For more information, please refer to Detection States and Modes in FBM. |
|
Reselection is not available | Hole Wizard features for a Wizard Holes operation can only be selected in Mastercam for SOLIDWORKS. Contact your Reseller for more information. |
|
Preview toolpath operations (FBM Drill/Wizard Holes) | Opens the Toolpath Operations Preview dialog box where you can view the list of operations FBM will generate using the current Features page list. |
|
Save parameters to defaults file | Makes the current toolpath settings the default for future toolpaths of this type. Saves the current values in the toolpath properties pages to the .mcam-defaults file specified in the machine group properties. |
|
Reload parameters from defaults file | Overwrites the current values in the toolpath properties pages with the toolpath's default parameters. These parameters are reloaded from the .mcam-defaults file specified in the machine group properties. |
|
Hide dialog | Minimizes the dialog box so that you can use other Mastercam functions, like changing your shading settings or the graphics window view. When finished, press [Esc] to maximize the dialog box. |
|
Tool Manager | Opens the Tool Manager. Use the Tool Manager to create and edit tool definitions and to work with tool libraries. When you close the Tool Manager, the toolpath dialog box will reappear just as you left it. |
|
Feed speed calculator | Opens the Feed & Speed Calculator dialog box where you can modify the calculated feed rate or spindle speed by adjusting the material and tool parameters. |
|
None |
Page window | This window displays all of the pages that are available to you, depending on the selected toolpath type. A green check mark indicates pages where data has changed in the current session. |
| None | Quick View Settings | This window summarizes key toolpath information from the Tool page, Coolant page, and Planes page. It updates automatically as you make changes to the different pages and is always visible. |
| None | Generate toolpath | When selected, automatically generates the toolpath when you click OK. For more information, refer to Accepting and Generating Toolpaths. |
|
OK | Generates the toolpath and closes the dialog box. If editing a toolpath, applies the changes and closes the dialog box. |
|
Apply | Applies your changes to the toolpath without closing the dialog box. |
|
Cancel | Closes the dialog box and cancels the toolpath creation. If editing a toolpath, any changes to the toolpath are discarded. |
Final contour pass
Allows additional cuts along the part boundaries, helping to remove uncut cusps left after a Parallel rough cycle. Available for Parallel rough pattern only. Choose All slices to perform the final contour pass on every slice or Last slice to perform the final contour pass on only the final slice. Spacing specifies the amount that will not be milled in the roughing pass.
Minimal curvature radius
Defines the minimum allowed curvature radius of each cut.
Type
Filters out toolpath regions based on the size of the toolpath. If the width of a toolpath region is less than or equal to the specified filter value, the region will be filtered out. This can be useful to avoid unnecessary machining.
- Inscribed circle: The width of a region is a maximum circle diameter, which could be inscribed into the toolpath within this region.
- Diagonal length: The width of a region is a diagonal of an axis-aligned bounding box built around the toolpath within this region.
Threshold value in percentage of tool diameter
Enter a value to be used for filtering the tool motion. Segments or pockets smaller than the value specified are removed from the toolpath. Use to eliminate unnecessary cuts in the toolpath, such as at the very center of a pocket.
Overlap threshold
Enter a value to specify an additional machining area that requires processing after the tool has broken through the thin wall of the stock material. This usually occurs at the end of slots machining. This feature makes the exit safer without instantly going through the thin walls.
Extend cuts for stock
Extends the toolpath to the top of the stock material when it is located above the ceiling surfaces.
Smooth corners
Creates fillets in the sharp corners of the toolpath. Selecting this parameter shows the Smooth distance/stepover percent field. In this field, enter the value for the amount of smoothing measured from the original contour and the rounded corner. Note that the fillet will not be applied to the outer contour. For that functionality, use the Smooth final contour parameter.
Smooth links
Smooths the links within a group. The last segments of the previous contour and the first segments of the next contour are trimmed. The connecting link connects diagonally. Where there is blend spline linking, the connection is defined as an 's' type link. Selecting this parameter shows the Smooth link gap size/stepover percent field. This field controls the smoothness of the blend spline link between neighbor cuts within a group.
Smooth final contour
Creates fillets in the sharp corners of the outer contour. Selecting this parameter shows the Smooth distance/stepover percent field, where you can enter the radius of the fillet as a percentage of the stepover distance.
Minimize links
Attempts to use part of the actual toolpath contour for linking instead of applying retraction moves. This option is available only for offset roughing.
Filter by
Defines which part of the toolpath can be filtered (entire region or a certain contour).
Type
Defines the type of filtering to use.
- Inscribed circle: All of the part slices are checked with an inscribed circle to detect and filter the slices that are smaller than the threshold.
- Diagonal length: The diagonal of the axis-aligned bounding box created around a part slice is used to filter slices that are smaller than the threshold.
- Circumscribed circle: All of the part slices are checked with a circumscribed circle to detect and filter the slices that are smaller than the threshold.
Threshold value in percent of tool diameter
Defines the filtering threshold as a percentage of the flat tool diameter.
Minimum segment length in percent of tool diameter
Defines the filtering threshold that is applied to toolpath motions only. It is defined as a percentage of the flat tool diameter.
Use lead-outs
Enables the Lead-out radius in percentage of stepover parameter, which defines the radius for the offset roughing default lead outs as a percentage of the stepover.
Remove corner pegs
To remove uncut material, this parameter modifies the stepover value and adds extra cuts to the corners. You cannot use Remove corner pegs when the modified stepover is less than 5% of the tool diameter, which occurs when the tool has a small flat cutting area.





