Use this page to
establish the collision control parameters for your Multiaxis
toolpath. Collision control establishes clearance values and instructs
the toolpath how to move the tool to avoid a collision. A single
strategy is usually all that is needed. However you have the ability
to set four different strategies if necessary. Additional collision control strategies can be set on the Additional collision control strategies page.
Common Toolpath Parameter Controls
Status
Select to activate a collision control strategy. Each subsequent strategy is dependent on the one above it.
Check
Select the sections of tool to perform gouge checking on. Use any combination of flute, shoulder, shank, or holder.
Strategy and parameters
Select the initial strategy from the upper drop-down list. Use the secondary drop-down list and checkbox to refine the parameters for the strategy, if available. The selections made here dictate which collision control sub-branches become available.
Machining surfaces
Select to perform gouge checking on all drive surfaces. The checking tolerance will be set to the toolpath cut tolerance.
Drive surfaces
Select to check for collisions against the drive surfaces.
Check surfaces
Select to enable the selection of check surfaces. Click Select to return to the graphics window for surface selection.
Stock to leave
Enter the amount of material to leave on the part model when the operation is finished.
The Stock to leave field is automatically populated from the Machining surfaces offset value on the Cut Pattern page, and not editable if Flute is selected in the Check section.
Tolerance
Enter the gouge checking tolerance to use for check surfaces.
The Tolerance field is automatically populated from the Cut tolerance value on the Cut Pattern page.
Check link motions for collision
Select to evaluate linking motion for collisions. Linking is motion between cuts.
Trim contour for safe retract
Trims the contour to allow for safe retract of the tool during linking motion.
Cylindric
Select to define tool clearance values with a cylinder around the tool sections.
Conical
Select to define tool clearance values with a cone around the tool sections. The lower offset value applies to the end of the section that is closest to the tool tip.
Holder
Enter a distance that is the closest the tool holder should get to the part being cut. This distance is applied to check surfaces, if selected. The lower offset value is closest to the tool tip when using Conical for the Clearance type.
Shank
Enter a distance that is the closest the tool shank should get to the part being cut. This distance is applied to check surfaces, if selected. The lower offset value is closest to the tool tip when using Conical for the Clearance type.
Shoulder
Enter a distance that is the closest the tool shoulder should get to the part being cut. This distance is applied to check surfaces, if selected. The lower offset value is closest to the tool tip when using Conical for the Clearance type.
Angular Clearance
Enter an angle for clearance around the tool. The angle is measured from the tool tip to the widest point of the tool. The value entered is applied in an outward direction.
Check gouge between positions
Select to evaluate for gouging between all toolpath positions. This is particularly useful on flat surfaces where positions may only be created at each end. This is recommended to be active for all toolpaths.
Extends tool to infinity
Select to extend the tool length in the toolpath calculation rather than using the actual tool length. This is useful when using a small compensation surface, such as a cylinder, that may be farther than the tool length away from the pattern surface.
Check tip radius for contours
Select to evaluate the tip radius during contours when tilting the tool to avoid a collision. Use when a calculated solution cannot be found. A secondary collision strategy will generally be needed to avoid collisions. Available only when using the Tilt tool strategy.
Check tip radius for links
Select to evaluate the tip radius during linking moves when tilting the tool to avoid a collision. Use when a calculated solution cannot be found. A secondary collision strategy will generally be needed to avoid collisions. Available only when using the Tilt tool strategy.