Cut Pattern: Blade Expert dialog box
Use the Cut Pattern page to establish the cut pattern parameters for your Multiaxis Blade Expert toolpath. Cut pattern settings determine the geometry your tool follows and how it travels along that geometry.
Common Toolpath Parameter Controls
Machining
Choose a machining pattern from the drop-down list.
- Roughing: Creates layers and slices between blades / splitters.
- Blade finishing: Creates passes only on blades / splitters using layers.
- Hub finishing: Creates passes only on the hub using slices.
- Fillet finishing: Creates passes only on the fillets between the blades / splitters and hub.
Strategy
Choose a machining strategy from the drop-down list.
- Offset from hub: All cuts are parallel to the hub.
- Offset from shroud: All cuts are parallel to the shroud.
- Morph between shroud and hub: Cuts are a blend between the shroud and hub.
- Swarf: Available for Blade finishing only. Finishes the blade with a single cut.
Contour
Choose an option to control the tool motion when using Blade finishing.
- Full: Create a full pass around the blade.
- Full (trim trailing edge): Removes cuts around the trailing edge.
- Full (trim trailing / leading edges): Removes cuts around the trailing and leading edges.
- Left side: Only the left side of the blade is cut.
- Right side: Only the right side of the blade is cut.
- Pocket: Creates passes as if cutting the walls of an open pocket between blades. Only the left side of the right blade and the right side of the left blade are cut.
Method
Choose the sorting method from the drop-down list. The options vary based on the machining pattern selected. In general, the leading edge is closest to the center of the hub with the trailing edge closest to the circumference of the hub.
Ordering
Choose the sorting order from the drop-down list. The options vary based on previously select items.
Cut direction
Enabled when Blade finishing is selected. Choose the cut direction from the drop-down list.
Maximum number (Depth step / Stepover)
Select to create layers or slices using an integer. Enter the number of layers or slices to create. Layers are created only up to the shroud. The number of layers is truncated if the combination of Maximum number and distance takes the layers above the shroud.
Maximum distance (Depth step / Stepover )
Select to create layers or slices based on a distance value. Enter the distance between layers or slices. The actual distance for the toolpath varies when using Morph between shroud and hub.
Distance (Depth step)
Enter the distance between layers. A value must always be entered in order to generate the appropriate cuts.
Intermediate slices
Enter the number of depth cuts to create on the first slice. Intermediate slices create a shallower entry cut before the tool is fully engaged in material.
First cut spindle speed (RPM)
Specifies a first cut RPM override value. The first cut of each slice uses the specified RPM value before transitioning to the RPM defined on the Tool page.
Avoid incomplete depths
Select to cut only complete layers. If the tool cannot reach a portion of a given layer it will not be cut.
Rough all depths
Select to remove as much material as possible. The tool will cut everything it can reach which may result in incomplete layers being left.
Start at (%)
Enter a value that defines the start position of cuts when using Morph between shroud and hub. The value is used as a percentage of the blade height, with 0% at the root of the blade (hub).
End at (%)
Enter a value that defines the end position of cuts when using Morph between shroud and hub. The value is used as a percentage of the blade height, with 100% at the top of the blade (shroud).
Number of cuts
Enter the number of cuts to create for fillet finishing on the selected side of the fillet.
Blade overlap
Enter the overlap distance for the selected side of the fillet. An overlap prevents standing material from being left on the fillet.
Maximum number (Blade / Hub side)
Select and enter the number of cuts to create on the selected side of the fillet.
Maximum distance (Blade / Hub side)
Select to use the Distance value specified in the Both sides to determine the number of cuts for fillet finishing.
Big tool diameter
Enter the roughing tool diameter. The value is used to calculate the remaining material after roughing.
Distance (Both sides)
Enter the distance between cuts for fillet finishing. A value must be entered when using Maximum distance in order to generate the appropriate cuts.





