Use this page to
establish the entry and exit motion for your Multiaxis toolpath.
Entry and exit settings control the tool motion as it makes and
breaks contact with the part.
Common Toolpath Parameter Controls
Always use
Select to force an entry/exit to occur where vectors are removed due to check surfaces in the middle of a pass. The entry/exit motion will occur even if the gap is smaller than the values in the Keep tool down within parameter.
Length
Enter a percent of the tool diameter in the first field, or a numerical value in the second field, to use for the length of the curve. The fields are linked so that entering a value in one will automatically update the other. The value is measured parallel to the tool motion.
Thickness
Enter a percent of the tool diameter in the first field, or a numerical value in the second field, to use for the thickness of the curve. The fields are linked so that entering a value in one will automatically update the other. The value is measured perpendicular to the tool motion.
Height
Enter a value to use for the height of the curve. The value is measured along the tool axis so the motion is generated above the part.
Feed rate percentage
Enter a number to use as the feed rate percentage value. The percentage you enter here is multiplied by your toolpath feed rate to establish the feed rate for lead moves. You can reduce or increase the feed rate for lead moves with this value.
Perpendicular
Click to set the pivot angle to 90 degrees.
Tangent
Click to set the pivot angle to 0 degrees.
Pivot angle
Enter a value in degrees to pivot the curve. The value is measured from the tool's contact point with the part and parallel to the tool motion.
Direction
Select left or right for the direction to apply the thickness value.
Copy
Click to copy the entered values up or down. Up will copy the exit values to the entry fields. Down will copy the entry values to the exit fields.
Curve tolerance
Enter a distance to control the linear approximation of the curve. A lower value will follow the theoretical curve more closely but may also create more lines of code in the NC file.
Closed loop overlap
Available only for Curve and Swarf toolpaths. Select to create an overlap distance around the toolpath's entry point. Enter a percentage of the tool diameter in the first field or an absolute value in the second field. The fields are tied together. Changing one updates the other. The distance is applied equally on each side of the entry position.
Edge blend options
Only available for Flow, Multisurface, and Port toolpaths. Select an option from the drop-down. Use the options to control how the tool enters and exits the toolpath.
Taper distance
Only available for Flow, Multisurface, and Port toolpaths. Select and enter a distance from the entry or exit to begin the taper motion.
Taper passes
Only available for Flow, Multisurface, and Port toolpaths. Select and enter the number of passes to create for the entry or exit motion.
Taper angle
Only available for Flow, Multisurface, and Port toolpaths. Enter the angle for the taper passes.