Linking
Use the Linking page to define default linking moves and other overall settings. Subpages for areas, regions, and slices let you select specific strategies for each type of group.
This Linking page is used by a number of Mastercam's multiaxis toolpaths. Other multiaxis toolpaths use different versions of this page.
Linking settings determine how the tool moves when it is not in contact with the part (air cutting). Mastercam groups cuts in three ways for the purpose of defining linking moves:
- Areas. An area is a geographically distinct section of your part that contains a group of cuts, but does not necessarily have a distinct boundary. Areas are only used when creating roughing operations.
- Regions. A region is a distinct feature of your part, such as a boss or pocket. Regions are defined for both roughing and finishing operations.
- Slices. Slices are the series of individual cuts as the tool cuts closer to the part.
The picture below illustrates the differences between these types of groups:
- The green moves are links within an area.
- The red moves are links between regions.
- The yellow moves are links between slices.
Not all options are available for all toolpaths.
| Icon | Name | Description |
|---|---|---|
|
Detect (FBM Drill) | Analyzes the solid model and detects features based on the Feature Based Machining (FBM) operation's current parameters. View the results of all detected features and their machining information in the Features page. For more information, please refer to Detection States and Modes in FBM. |
|
Reselection is not available | Hole Wizard features for a Wizard Holes operation can only be selected in Mastercam for SOLIDWORKS. Contact your Reseller for more information. |
|
Preview toolpath operations (FBM Drill/Wizard Holes) | Opens the Toolpath Operations Preview dialog box where you can view the list of operations FBM will generate using the current Features page list. |
|
Save parameters to defaults file | Makes the current toolpath settings the default for future toolpaths of this type. Saves the current values in the toolpath properties pages to the .mcam-defaults file specified in the machine group properties. |
|
Reload parameters from defaults file | Overwrites the current values in the toolpath properties pages with the toolpath's default parameters. These parameters are reloaded from the .mcam-defaults file specified in the machine group properties. |
|
Hide dialog | Minimizes the dialog box so that you can use other Mastercam functions, like changing your shading settings or the graphics window view. When finished, press [Esc] to maximize the dialog box. |
|
Tool Manager | Opens the Tool Manager. Use the Tool Manager to create and edit tool definitions and to work with tool libraries. When you close the Tool Manager, the toolpath dialog box will reappear just as you left it. |
|
Feed speed calculator | Opens the Feed & Speed Calculator dialog box where you can modify the calculated feed rate or spindle speed by adjusting the material and tool parameters. |
|
None |
Page window | This window displays all of the pages that are available to you, depending on the selected toolpath type. A green check mark indicates pages where data has changed in the current session. |
| None | Quick View Settings | This window summarizes key toolpath information from the Tool page, Coolant page, and Planes page. It updates automatically as you make changes to the different pages and is always visible. |
| None | Generate toolpath | When selected, automatically generates the toolpath when you click OK. For more information, refer to Accepting and Generating Toolpaths. |
|
OK | Generates the toolpath and closes the dialog box. If editing a toolpath, applies the changes and closes the dialog box. |
|
Apply | Applies your changes to the toolpath without closing the dialog box. |
|
Cancel | Closes the dialog box and cancels the toolpath creation. If editing a toolpath, any changes to the toolpath are discarded. |
First entry
Select how the tool approaches the part for the first time. The selected area or distance is where the tool begins the remaining entry motion. Additionally, select whether to use lead-in values set on the Default Lead-in/out page. Direct ignores the clearance area and distances while moving directly to the part.
If the Don't use ramp/Use ramp option is available, you can choose to create the linking move on a ramp into the cut.
Last exit
Select how the tool leaves the part upon completion of the toolpath. The tool motion stops at the selected area or distance. Retract to clearance area through tube center is intended for geometry that is similar to a port. The tool retracts along the tool axis to avoid any collisions. Additionally, select whether to use lead-out values set on the Default Lead-in/out page. Direct ignores the clearance area and distances while ending on the part.
If the Don't use ramp/Use ramp option is available, you can choose to create the linking move on a ramp into the cut.
Start from home position
Select to begin the first entry from the home position.
Return to home position
Select to move to the home position after the last exit.
Home position
Select the home position.
Type (Clearance plane)
Select a clearance area type from the drop-down list. The options are Automatic, Cylinder, Plane, or Sphere.
Direction (Clearance plane)
Sets the clearance plane along the X, Y, or Z axis.
Height
Sets the height at which the tool moves to and from the part.
Rapid distance
Enter an incremental distance above the part where the tool is moving at a rapid feed rate. This distance is also where the tool axis will be aligned properly for contact with the part. Above this distance the tool axis will be in transition for its orientation in the clearance area.
Feed distance
Sets the height above the part to switch from rapid to feed movements.
Air move safety distance
Enter the minimum distance above the part for the tool to travel in the clearance area.
Smooth corners
Select the check box and enter a value for creating fillets at sharp corners of the toolpath.
Type (Links)
Select the type of links that will be used when large gaps are encountered.
Apply on gaps larger than (in percentage of tool diameter)
Enter a threshold value as a percentage of the tool diameter. Once the gap length becomes greater than the threshold, the link type specified for large gaps will be used.
Radius (Lead in/out)
The desired radius for the lead in/out.
Min radius (Lead in/out)
The minimum acceptable radius for the lead in/out.
Angle step for rapid moves
Enter an angle value to define the maximum rapid move step to take around a cylinder when the tool is in the clearance area.
Select the default strategy to be used for Within groups and Between groups. Then, if the Don't use ramp/Use ramp option is available, you can choose to create the linking move on a ramp into the cut.
Small gaps
Select the type of motion the tool should make when a small gap is encountered. Small gaps are less than the value specified for Small gap size. Additionally, select whether to use lead values set on the Default Lead-in/out page.
Large gaps
Select the type of motion the tool should make when a large gap is encountered. Large gaps are greater than the value specified for Small gap size. Additionally, select whether to use lead values set on the Default Lead-in/out page.
Small gap size
Enter a value for a small gap size.
In percentage of tool diameter
Select and enter a percentage to use for calculating small gaps. Any gap that is greater than the calculated value is considered a large gap.
As value
Enter a value to use for toolpath calculation. Moves or gaps greater than this value are considered as large.
Type
Select a clearance area type from the drop-down list. The options are automatic, cylinder, plane, or sphere. Cylinder is currently the only option for a Port Expert toolpath.
Direction
Sets the clearance plane along an axis or aligns the clearance cylinder to an axis.
- X-axis, Y-axis, or Z-axis: Aligns the clearance cylinder to an axis , or sets the clearance plane along the X, Y, or Z axis.
- User defined direction: Aligns the cylinder to a user-defined direction, or sets the clearance plane along a user-defined direction.
- Machining direction: Triangular Mesh only. Aligns the clearance plane of a Triangular Mesh toolpath with the current tool plane.
Through point / Around point
Enter the coordinates for the cylinder center line to pass through, or the coordinates for the sphere to be centered around. The Select button returns you to the graphics window to select a point to fill in the values.
Radius / Height
Enter a radius value when using Cylinder or Sphere for clearance type. Enter a height value when using Plane. The Select button returns you to the graphics window for height selection. The coordinate of the selected point, relative to the current construction plane and X, Y, or Z radio button selection, is used as the height value.
Incremental height
Enter an incremental height for clearances. The Select button returns you to the graphics window for height selection. The coordinate of the selected point, relative to the current construction plane and X, Y, or Z radio button selection, is used as the height value.
Interpolation tilt angles
Sets the interpolation tilt angle for the approach/exit of the tool motion. Enter values for Angle step for rapid moves and Angle step for feed moves to set the maximum segment length of the cylinder or sphere which is defined by an angle.
Keep initial orientation until distance
Available only when Plane is selected for the Clearance area Type. Select and enter a distance to retract the tool along it's current tool axis orientation. The tool axis will transition to the normal of the selected plane once it reaches the entered distance from the part.
Angle step for rapid moves
Enter an angle value to define the maximum rapid move step to take around a cylinder when the tool is in the clearance area.
Angle step for feed moves
Enter an angle value to define the maximum feed move step to take around a cylinder when the tool is in the clearance area.
Rapid distance
Enter an incremental distance above the part where the tool is moving at a rapid feed rate. This distance is also where the tool axis will be aligned properly for contact with the part. Above this distance the tool axis will be in transition for its orientation in the clearance area.
Entry feed distance
Sets the height above the part at which to switch from rapid to feed movements during the toolpath approach.
Exit feed distance
Sets the height above the part at which to switch from feed to rapid movements during the toolpath retract.
Air move safety distance
Enter the minimum distance above the part for the tool to travel in the clearance area.
Feed distance
Sets the height above the part at which to switch from rapid to feed movements.
Arc fit
Creates tangential arcs for approaching and retracting link segments. You can choose to retract to Clearance area, Rapid distance, or Feed distance.
Arc radius
Set the radius of the tangential arcs.





