Tool Axis Control: Flow, Multisurface, Port
Use this page to
establish the tool axis control parameters for your Multiaxis
Flow, Multisurface,
or Port toolpath. Tool axis control
settings determine the tool's orientation in relation to the geometry
being cut.
Parameters
Common Toolpath Parameter Controls
Tool axis control
Use the drop-down list to select the tool axis control method. Click Select to return to the graphics window to select appropriate entities. The number of entities is displayed to the right of the Select button.
- Lines: Aligns the tool axis along the selected lines. The tool axis will be interpolated for areas between the selected lines. Select the lines in such a way that the chaining arrow is pointing towards the tool spindle.
- Pattern surface: Keeps the tool axis normal to a selected surface. Pattern surface is the only option available for 3-axis output. For 3-axis output, Mastercam projects the curves onto the tool axis surfaces. The projected curves become the tool contact positions.
- Plane: Keeps the tool axis normal to a selected plane.
- From point: Limits the tool axis to originate from a selected point.
- To point: Limits the tool axis to terminate to a selected point.
- Chain: Aligns the tool axis along a line, arc, spline, or chained geometry.
- Boundary: Aligns the tool axis within or on a closed boundary. If the cut pattern surface normal is within the boundary, the tool axis stays aligned with the cut pattern surface normal.
Output format
Select 4-axis or 5-axis from the drop-down list.
- 4-axis: Allows one plane of rotation selected under Rotary axis.
- 5-axis: Allows tool axis rotation in any plane.
Backplot rotary axis / Rotary axis
Select the X, Y, or Z-axis to be used in backplot to represent the rotary axis. Match this setting to the rotary axis capabilities of your machine for 4-axis output.
Lead/lag angle
Enter the angle to tilt the tool.
- Lead: Tilts the tool forward in the direction of the toolpath.
- Lag: Tilts the tool backward from the direction of the toolpath.
Side tilt angle
Enter the angle to tilt the tool. Tilts the tool right or left while traveling in the direction of the toolpath.
Angle increment
Select the checkbox and enter a value. The value is an angular measurement between adjacent tool vectors. An additional vector will be added to the toolpath when the angle between calculated vectors is greater than the angle increment value.
Tool vector length
Enter a value that controls the toolpath display by determining the length of the tool axis at each tool position. Also used as the vector length in the NCI file. For most tools, use 1 inch or 25 mm as the tool vector length. Entering a smaller value provides less onscreen display of the toolpath. When you are satisfied with the toolpath display, change the tool vector length to a larger value to create a more accurate NCI file.
Minimum tilt
Select to enable the minimum tilt options. Minimum tilt adjusts the tool vectors to prevent potential collisions with the part.
Maximum angle increment
Enter the maximum angle the tool will be allowed to move through between adjacent moves.
Shank and holder clearance
Enter a value to use as clearance for the shank and holder. Use when additional clearance is needed to avoid the part or fixture.