Tool Axis Control: Rotary
Use this page to
establish the tool axis control parameters for your Multiaxis
Rotary toolpath. Tool axis control settings
determine the tool's orientation in relation to the geometry being
cut.
Parameters
Common Toolpath Parameter Controls
Output format
Output format is locked at 4-axis for a Rotary toolpath. Click Select to return to the graphics window to select a point on the rotary axis.
Backplot rotary axis / Rotary axis
Select the X, Y, or Z-axis to be used in backplot to represent the rotary axis. Match this setting to the rotary axis capabilities of your machine for 4-axis output.
Use center point
Select to generate tool vectors that terminate at the selected point. Deselect to generate tool vectors that are normal to the surface.
Axis dampening length
Enter a value that determines the position of the tool axis based on a specific length away from the surface of the part. A longer axis dampening length creates less angular change between the vectors. A shorter length provides more tool positions and a toolpath that adheres closely to the surface.
Lead/lag angle
Enter the angle to tilt the tool.
- Lead: Tilts the tool forward in the direction of the toolpath.
- Lag: Tilts the tool backward from the direction of the toolpath.
Maximum step
Enter a value to control the distance between passes. The distance is measured parallel to the axis of rotation.
Maximum angle increment
Enter the angle the part indexes between passes, in degrees. The space between cuts will vary based on part geometry.
Start angle
Enter an angular value to begin the toolpath. The angle is applied relative to the tool plane used to cut the geometry.
Sweep angle
Enter an angular value to determine the range of the axial cuts. The angle is measured from the start angle value.
Tool vector length
Enter a value that controls the toolpath display by determining the length of the tool axis at each tool position. Also used as the vector length in the NCI file. For most tools, use 1 inch or 25 mm as the tool vector length. Entering a smaller value provides less onscreen display of the toolpath. When you are satisfied with the toolpath display, change the tool vector length to a larger value to create a more accurate NCI file.