Cut Parameters: Saw
Use the Cut Parameters page to configure the Saw toolpath's cutting passes. Follow this general outline:
- Enter values for different cutting parameters and compensation options.
- Use the pages nested below the Cut parameters page to activate and configure advanced toolpath features.
| Icon | Name | Description |
|---|---|---|
|
Detect (FBM Drill) | Analyzes the solid model and detects features based on the Feature Based Machining (FBM) operation's current parameters. View the results of all detected features and their machining information in the Features page. For more information, please refer to Detection States and Modes in FBM. |
|
Reselection is not available | Hole Wizard features for a Wizard Holes operation can only be selected in Mastercam for SOLIDWORKS. Contact your Reseller for more information. |
|
Preview toolpath operations (FBM Drill/Wizard Holes) | Opens the Toolpath Operations Preview dialog box where you can view the list of operations FBM will generate using the current Features page list. |
|
Save parameters to defaults file | Makes the current toolpath settings the default for future toolpaths of this type. Saves the current values in the toolpath properties pages to the .mcam-defaults file specified in the machine group properties. |
|
Reload parameters from defaults file | Overwrites the current values in the toolpath properties pages with the toolpath's default parameters. These parameters are reloaded from the .mcam-defaults file specified in the machine group properties. |
|
Hide dialog | Minimizes the dialog box so that you can use other Mastercam functions, like changing your shading settings or the graphics window view. When finished, press [Esc] to maximize the dialog box. |
|
Tool Manager | Opens the Tool Manager. Use the Tool Manager to create and edit tool definitions and to work with tool libraries. When you close the Tool Manager, the toolpath dialog box will reappear just as you left it. |
|
Feed speed calculator | Opens the Feed & Speed Calculator dialog box where you can modify the calculated feed rate or spindle speed by adjusting the material and tool parameters. |
|
None |
Page window | This window displays all of the pages that are available to you, depending on the selected toolpath type. A green check mark indicates pages where data has changed in the current session. |
| None | Quick View Settings | This window summarizes key toolpath information from the Tool page, Coolant page, and Planes page. It updates automatically as you make changes to the different pages and is always visible. |
| None | Generate toolpath | When selected, automatically generates the toolpath when you click OK. For more information, refer to Accepting and Generating Toolpaths. |
|
OK | Generates the toolpath and closes the dialog box. If editing a toolpath, applies the changes and closes the dialog box. |
|
Apply | Applies your changes to the toolpath without closing the dialog box. |
|
Cancel | Closes the dialog box and cancels the toolpath creation. If editing a toolpath, any changes to the toolpath are discarded. |
Compensation type
Choose how you want to handle cutter compensation:
- Computer: Computes the compensated toolpath and does not output control codes for compensation.
- Control: Outputs control codes for compensation and does not compute the compensated toolpath.
- Wear: Computes the compensated toolpath and outputs control codes for compensation. Compensation direction in the computer and control are the same.
- Reverse wear: Computes the compensated toolpath and outputs control codes for compensation. Compensation direction in the computer and control are opposite.
- Off: Programs the tool tip directly on the chained geometry and does not output compensation codes.
The available options are determined by the active control definition.
Compensation direction
Sets the machining direction for the toolpath. Choose one of the following options:
- Climb: Cuts in one direction with the tool rotating in the opposite direction of the tool motion.
- Conventional: Cuts in one direction with the tool rotating in the same direction as the tool motion.
The Compensation direction controls the arbor side of the saw relative to the spindle direction that is defined for the tool in the Tool page. The Spindle direction is set as if you are looking at the saw blade from the aggregate side down the arbor. For example, if the spindle rotation for the saw is CW (looking down the arbor), and you set the Compensation direction to Climb, the arbor side of the resulting toolpath is to the right. Use the following chart as a guideline for correctly setting these parameters for Saw toolpaths.
| Compensation Direction | Spindle Rotation | Arbor Side |
|---|---|---|
| Climb | CW | Right |
| Conventional | CW | Left |
| Climb | CCW | Left |
| Conventional | CCW | Right |
Tip compensation
Sets amount to offset from the tool's center or tip. Choose Center to have the offset calculated from the center of the saw tool. Choose Tip to have the offset calculated from the tips of the teeth of the saw tool. Used for touching the tool off the part.
Stock to leave on walls
Sets the amount of stock on selected vertical machining geometry. Enter a positive value if you do not want to remove all stock or enter a negative value to remove more stock. If the machining geometry (or a portion of it) is not vertical, Mastercam interpolates a value between the Stock to leave on floors and Stock to leave on walls amounts.
Stock to leave on floors
Sets the amount of stock on selected horizontal machining geometry. Enter a positive value if you do not want to remove all stock or enter a negative value to remove more stock. If the machining geometry (or a portion of it) is not horizontal, Mastercam interpolates a value between the Stock to leave on floors and Stock to leave on walls amounts.





