Drilling Blind Holes Using a Block Drill Toolpath
Blind holes are drilled partially through the stock, often using a brad point drill. You can set up Mastercam to automatically detect and drill blind holes using the block drilling toolpath. Mastercam gives preference to the brad point drills for creating these holes.
To drill blind holes, you will need to:
- Set up the drill block by adding brad point tools of the diameter of the blind holes. Drill blocks are the component Mastercam uses to represent gang tooling.
- Set up the stock. Mastercam requires a stock definition so that it can tell the difference between through holes and blind holes. Mastercam looks at all the arcs selected for the block drill toolpath. Arcs that are above the bottom of the stock and lower than the top of the stock are drilled as blind holes. Arcs at the bottom of the stock or lower are drilled as through holes. To avoid excessive tear-out, Mastercam will not use the brad point drill tools in a block drill to drill through holes.
- Choose Block Drilling from the Router Toolpaths contextual tab.
- Use the Toolpath Hole Definition function panel to select the holes. Mastercam automatically places you in window selection mode. Since you must select arcs instead of points, some of the other selection tools are unavailable.
- Expand the Depth filters, under the Features list. Choose one of the following:
- Use highest Z depth: Keeps the selected entities at the highest Z depth. Filters out entities at other depths.
- Use lowest Z depth: Keeps the selected entities at the lowest Z depth. Filters out entities at other depths.
- Window select the arcs and select OK.
- When the Toolpath dialog box displays, select the Tool page.
- Right-click in the tool selection window and choose Get block drill.
- In the Drill Block Selection dialog box, select a drill block that is equipped with the brad point tools. Expand the drill block and use the right-click menu to view and edit the tools in the block, as necessary.
- When you are finished, choose OK to close the Drill Block Selection dialog box.
- Use the other Toolpath dialog box property pages to enter all drilling parameters for the toolpath. If necessary, use the Axis Combination page to choose the axis combination that has been defined for the selected block drill.
- Choose OK to create the toolpath.





