Use this tab to
create a lathe Dynamic Rough toolpath. The toolpath is designed
for hard materials cut only with button inserts, such as a radius or ball.
The dynamic motion allows the
toolpath to cut gradually, remain engaged in the material more
effectively, and use more of the surface of your insert, extending
the tool life and increasing the cutting speed. See the
following graphics for tool motion differences.
Choose whether the cutting method is one-way or zig-zag, and select a toolpath orientation from
the Rough direction list. Use
the graphics as a guide for entering the different toolpath dimensions.
Use the options on the right side of the tab to select the type
of cutter compensation and complete the toolpath by adding advanced
features such as a semi-finish pass, lead in/out moves, and toolpath
filtering.
One way
The tool cuts the part in one direction, comes up, goes back to the beginning, and
cuts again. The picture in the dialog box changes to show this tool motion.
Zig-zag
The tool cuts the part in a back and forth motion. The picture in the dialog box
changes to show this tool motion.
Rough direction
Determines the angle that the tool cuts into the part. This angle is relative to
the rough direction of OD, ID, Face, or Back. Click the corresponding illustration from the drop-down.
Stepover
Determines the amount of material removed with each pass.
The Stepover is a percentage of the tool radius, not the diameter.
Toolpath radius
Determines the radius of the toolpath used to enter and exit each cutting path.
The Toolpath radius is a percent of the tool radius, not the diameter.
Stock to leave in X
Determines how much stock remains in the X direction when the operation is finished.
Typically, this would be removed by a separate finish operation.
Stock to leave in Z
Determines how much stock remains in the Z direction when the operation is finished.
Typically, this would be removed by a separate finish operation.
Prevent up cutting
Allows you to specify the non-cutting portion of a round insert. To activate the function, select the checkbox, and then click Non-cutting region to display and edit the function's settings.
Compensation type
Choose how you want to handle cutter compensation.
The options that are available are determined by the active control definition.
- Computer: Mastercam computes the compensated toolpath and does not output control
codes for compensation.
- Off: Mastercam programs the tool tip directly on the chained geometry and does not
output compensation codes.
Optimize cutter compensation in control
This field is available only when Cutter compensation is set to Control on the parameters tab, and applies only to that setting.
Compensation direction
Choose to offset the tool to the right or left of the toolpath. Even if cutter compensation
is set to Off, Mastercam uses this setting to determine the orientation of other
toolpath features such as multiple passes.
Roll cutter around corners
Inserts arc moves around the corners in the toolpath. Choose the type of arc move:
- None: Guarantees all
sharp corners.
- Sharp: Only rolls the tool around sharp corners of 135 degrees or less.
- All: Rolls the tool around all corners and creates smooth tool movement. The radius
of the arc moves equals the radius of the tool.
This option is available only when
Compensation in computer is turned on.
Semi finish
Select this option to create a semi-finish pass after the final roughing pass. This
pass follows the contour of the part with the roughing tool, preparing it for the
actual finish operation. Click to configure the semi-finish pass.
Lead in/out
Select to add lead in and lead out moves only to the semi finish passes. Click
to edit the moves.
Plunge parameters
Click to define how the tool handles undercuts on the toolpath along each
axis.
Filter
Select to eliminate unnecessary tool moves in the toolpath to create
smoother movement. Click to configure toolpath filtering options.
Tool inspection
Select to turn on tool inspection. If the checkbox is already selected,
click to open the Tool Inspection dialog box and change the tool inspection options.
Stock recognition
Adjusts the area of the stock to be removed by the roughing
operation. The following options are available:
- Remaining stock: Uses only stock remaining from previous operations.
- Use Stock for Outer Boundary: Uses a section of the stock boundary as the outer boundary.
- Extend Contour to Stock Only: Linearly extends the ends of the chained contour to
the stock.
- Disable the Stock Recognition: Provides no stock recognition.
Adjust stock
Opens the Adjust Stock dialog box and lets you adjust the area of the stock to be
removed by the roughing operation. This option is available only if:
- You define stock boundaries in the machine group properties.
- The chained contour lies entirely within the stock boundary.
- You select either the Use Stock for Outer Boundary or Extend Contour to Stock Only options.