Use this tab to create a drill toolpath along the part's
centerline. You do not need to create or chain any geometry to
create the toolpath. First, define the dimensions of the hole,
using the picture as a guide. Then, select a drill cycle and enter
the drilling parameters.
Depth
Determines the location of the bottom of the drill hole. This can be measured using
Absolute or Incremental values, and is calculated differently for each. Click Depth and select a point on the geometry or enter a value.
Absolute
Measures the position relative to the origin.
Incremental
Measures the position relative to the drill point.
Depth calculator button
Click to open the Depth Calculator so that you can calculate the proper drilling depth based
on a finish diameter and drill size, for example, when countersinking a hole.
Drill point
Enter the coordinates of the drill point in the X and Z fields or click to select a point from the graphics window.
Clearance
A safe point along the drilling axis to which the tool rapids before approaching
the part. This can be measured using Absolute or Incremental values, and is calculated
differently for each. If drilling towards the left, this value must be greater or
equal to the retract value. If drilling to the right, the value must be less than
or equal to the retract value. Click to select a point on
the geometry or enter a value.
From stock
Measures an incremental position relative to the current stock plane. Enabled only
if a stock boundary is defined in the machine group properties. If the stock definition
changes, this point is recomputed when you regenerate the drilling operation.
Retract
When choosing incremental, the value you enter determines how far above the top of
the hole the tool stops rapiding and begins traveling at the programmed feed rate
towards the stock. This can be measured using Absolute or Incremental values, and is calculated
differently for each.
When choosing Absolute, the value you enter determines how far
from the origin the tool stops rapiding and begins traveling at the given feed rate
towards the stock. The tool travels at the feed rate directly above the drill point
until it reaches the bottom of the hole.
If you have defined a stock boundary in the Machine Group Properties and choose Incremental,
the From stock option is enabled. See the previous From stock definition.
Cycle
Select a drill cycle from the drop-down list. Only cycles which have been defined
in the active control definition appear on this list.
First peck
Sets the depth for the first peck move, which plunges in and out of the material
to clear and break chips.
Subsequent peck
Sets the depth for all peck moves after the first peck. Peck moves plunge in and
out of the material to clear and break chips.
Peck clearance
Sets the depth that the tool rapids to between peck moves. The value is added to
the previously drilled peck depth. This option is enabled or disabled depending on
the selected drill cycle and whether the post supports peck clearance for that drill
cycle.
Retract amount
Determines the distance the tool moves away from the face of the part before it moves
to the start of the next cut.
Dwell
Sets the amount of time in seconds that the tool remains at the bottom of a drilled
hole. If using a peck drill cycle, the dwell value only applies to the final depth.
Shift
Sets the distance that a boring bar tool moves away from the wall of the toolpath
before retracting. This helps prevent gouging. This option only applies to bore bar
drill cycles.
Drill tip compensation
Select to adjust the drilling depth so that the drill fully breaks
through the material by the Breakthrough amount.
Breakthrough amount
Determines how far the tool goes past the final depth. Do this to ensure that the full diameter
of the tool breaks through the bottom of the hole. Enter a positive value only, or enter 0.0 to have Mastercam calculate the distance for you.