Plunge Cut Parameters
Use the Plunge Cut Parameters dialog
box to determine how you want the tool to handle undercuts along
the toolpath. You can choose to plunge into undercuts in either
X, Z, or both axes.
If you activate any of the plunge methods, use the other options
to tell Mastercam how to begin the plunge move. Choose the options
that fit best with your tool and part geometry.
Parameters
No plunging allowed
The tool skips over any undercuts in the chained path. You need to create another
toolpath to cut the undercut.
Allow plunging in both directions
The tool cuts into all undercuts on the chained path. Selecting this method activates the Clearance Angles
options. This option is unavailable for canned rough toolpaths.
Allow plunging in relief
The tool cuts into undercuts on the side cutting edge of the insert. Selecting this method activates the Clearance Angles
options.
Allow plunging in undercut
The tool cuts into undercuts on the end cutting edge of the insert. Selecting this method activates the
Front clearance angle option. This option is unavailable for canned rough toolpaths.
Front clearance angle
The front clearance angle prevents the tool front from cutting with the entire length
of the insert's front as the tool cuts up to the wall. Enter a value that is large
enough so that the tool holder does not scrape the material and break.
Back clearance angle
The back clearance angle prevents the tool back from cutting with the entire length
of the insert's back as the tool plunges to the next cut depth. Enter a value
that is large enough so that the tool holder does not scrape the material and break.
T
Start cut on tool front corner
Determines that the tool begins cutting with its front corner.
This method is preferable if the first move in the toolpath is not a plunge cut,
or if you want to finish the diameter adjacent to the first plunge move. For some
lathe tooling, such as flat bottom tools and tools with very small clearance angles,
starting the toolpath by cutting with the front corner might result in slight imperfections
such as witness marks on a finished diameter, and may require additional rough passes and/or
finish passes.
NOTE
This option is only available if you select Allow plunging in both directions or Allow plunging
in relief and you deselect Back clearance angle.
Start cut on tool back corner
Determines that the tool begins cutting with its back corner.
This method is preferable if the first move in the toolpath is a plunge move and
the diameter adjacent to the first move is already finished. For some lathe tooling,
such as flat bottom tools and tools with very small clearance angles, starting the
toolpath by cutting with the back corner of the tool might result in a smoother surface.
On certain toolpaths, this eliminates the need for additional rough passes and/or
finish passes.
NOTE
This option is only available if you select Allow plunging in both directions or Allow plunging
in relief and you deselect Back clearance angle.