Plunge Turn Finish Parameters
Use this tab to create the finish passes for a plunge turn toolpath. Select Finish to activate the options on this tab and create finish passes using the pictures on the tab as a guide. Use the parameters on the right side of the tab to enable advanced grooving features, such as retraction moves, cut direction, and plunge dwelling.
Deselect this option if you only want to create a roughing operation.
With plunge turn finish passes, there is no option for cutter compensation in control option. Cutter compensation is always set to computer and the compensation direction is set automatically.
Finish
Select to activate the options to create a finish pass. Deselect if there is no finish pass.
Stock clearance
Determines how far above the top of the groove the tool starts the first plunge and retracts after the last cut.
Stock to leave in X
Determines how much stock remains in the X direction when the operation is finished. Typically, this would be removed by a separate finish operation. For plunge turn toolpaths, if the value is less than 10% of the tool width, you receive a warning message.
Stock to leave in Z
Determines how much stock remains in the Z direction when the operation is finished. Typically, this would be removed by a separate finish operation.
Tool deflection backoff
Use this setting to prevent the tool's deflection from gouging the part's wall or floor. The first picture below shows the tool without deflection. The second picture shows an exaggerated view of the deflected tool and how it can gouge the part.
Plunge feed rate
Enter the feed rate used for plunge moves and select the appropriate radio button:
- in/rev or mm/rev: Calculates the value in inches per revolution, or millimeters per revolution for metric.
- in/min or mm/min: Calculates the value in inches per minute, or millimeters per minute for metric.
Turn feed rate
Enter the feed rate used for turning cuts (side moves) and select the appropriate radio button:
- in/rev or mm/rev: Calculates the value in inches per revolution, or millimeters per revolution for metric.
- in/min or mm/min: Calculates the value in inches per minute, or millimeters per minute for metric.
Plunge spindle speed
Enter the spindle speed used for plunge moves and select constant surface speed (CSS) or revolutions per minute (RPM).
Turn spindle speed
Enter the spindle speed used for turn moves and select constant surface speed (CSS) or revolutions per minute (RPM).
Roll cutter around corners
Inserts arc moves around the corners in the toolpath. Choose the type of arc move:
- None: Guarantees all sharp corners.
- Sharp: Only rolls the tool around sharp corners of 135 degrees or less.
- All: Rolls the tool around all corners and creates smooth tool movement. The radius of the arc moves equals the radius of the tool.
Rapid
Retracts the tool at the rapid feed rate. This option is not recommended if you are creating an angled groove.
Feed rate
Converts rapid moves into fast-feed rate moves. The rough and finish passes use the same fast-feed rate, so the interface displays the rate on both the rough parameters and finish parameters pages. Choose the appropriate option:
- in/rev or mm/rev: Calculates the value in inches per revolution, or millimeters per revolution for metric.
- in/min or mm/min: Calculates the value in inches per minute, or millimeters per minute for metric.
Approach clearance
Determines the approach move's distance from the stock on each pass. Approach clearance is similar to stock clearance in groove toolpaths. The tool rapids to the given position, and then feeds into the part.
Cut direction
Select Positive or Negative to machine all passes in a single direction.
Prevent hanging ring
A hanging ring occurs when the tool pushes off, rather than cuts, a small piece of material from the edge of the cut. Select a method, and the toolpath includes plunge moves to remove this extra material properly. Choose from the following:
- Don't prevent: Hanging ring prevention is off.
- Bi-Directional: Removes possible burrs from both sides of the cut
- Positive: Removes a possible burr from the positive side of the cut.
- Negative: Removes a possible burr from the negative side of the cut.
Plunge dwell
Specify the amount of tool dwell at the end of a plunge, and choose Seconds or the number of tool Revolutions. The plunge dwell ensures that a cut finishes completely (the stock has fully turned), before the toolpath moves on to the next cut.
Filter
Select to eliminate unnecessary tool moves in the toolpath to create smoother movement. Click to configure toolpath filtering options.





