Use the Thread Cut Parameters dialog
box to enter toolpath and cutting parameters for a thread toolpath.
Use the picture on the tab to learn about the specific fields.
NC code format
Determines how the thread stock will be removed when it is machined and lets you
choose how much flexibility you want in determining the amount of stock to be removed
per pass. Choose from Longhand, Box, Canned, and Alternating. The control definition
determines whether canned cycle output is enabled for the canned cycle, box, and
alternating selections.
This option also effects how the tool steps down for each pass to cut the thread.
By choosing Longhand or Canned, the tool is programmed as a modified flank infeed,
Box is a radial infeed, and Alternating is an incremental infeed.
Equal area
The thread will be made so that equal amounts of material are removed with each cut.
This option is enabled/disabled in the control definition.
Equal depths
The thread will be made so that the depth of each cut is equal. This option is enabled/disabled
in the control definition.
Amount of first cut
Determines the amount of stock to be removed with the first cut. This is expressed
as an incremental radius. The number of cuts it takes to remove all of the stock
is determined automatically from the amount of the first cut, the amount of last
cut, the thread shape, and the depth of the thread.
Number of cuts
Determines how many cuts the tool will make to cut the stock.
Multi start
Select to create a multi-start or multiple lead thread. Click to configure the multiple leads.
Amount of last cut
Enter the amount of stock to be removed with the last cut. The last cut is an
additional cut made before spring cuts. This number is expressed as an incremental
radius.
Number of spring cuts
Spring cuts remove material that remains because of tool or part deflection. Enter
a value to determine how many passes the tool needs to make at the finish depth.
Little or no material is removed. All passes are made at the same depth.
Stock clearance
Enter how far above the top of the stock the tool retracts between passes. This
is an incremental amount.
Overcut
Determines how far past the end of the thread the tool will go before retracting.
Select in/mm or revs to define the value you entered.
Anticipated pulloff
Represents the distance from the end of the thread that the tool begins to pull away
from the thread. This option is only available with canned (G76) threads, and is
enabled/disabled in the control definition. Select in/mm or revs to define the value you entered.
Acceleration clearance
Determines the distance necessary for the tool to accelerate to full speed in the
Z direction before it starts cutting the thread. This is an incremental distance
from the start of the thread along the Z axis. The distance is set automatically
if you select Compute. Choose in/mm or revs to define the value you entered.
Finish pass allowance
Determines the amount of stock to leave for spring cuts. This number is expressed
as an incremental radius.