Use the Tool Inspection dialog
box to establish points during operations where the machine can
be programmed to a specific position and stopped to allow you
to perform tool inspections. You can set the conditions on which
the tool inspections are performed, such as:
Additional options let you control whether a tool inspection
can occur during a pass or near the start or end of a pass. You
can also use reference points to get the tool in and out of the
cut, and send the tool to a selected point or to the home position
for the tool inspection position.
Use reference points
Select to set the tool position to a pre-defined reference point. When
you select this checkbox, the Reference Points dialog box opens, where you can select/create
the reference point(s) you want to use for your tool inspection. The reference point
is a point that the tool goes to on the way to and/or from the tool inspection position.
The reference point is also used on the initial approach from home and the final
retract going home. If you do not select or create a reference point in the Reference
Points dialog box, the Use reference points checkbox will remain deselected.
Once you have set a tool inspection reference point, the Reference Points button
is activated, allowing you to return to the Reference Points dialog box to edit your
settings.
Home position
Select to set the machine tool's default Home position as the tool
inspection position.
This radio button and the User defined radio button are exclusive options.
User defined
Select this radio button to define a specific position for your tool inspection.
This radio button and the Home position radio button are exclusive options. When you select this radio button, the following options are made available, allowing
you to define the tool inspection position:
D
Displays the D coordinate for the position of the tool inspection. Select the checkbox and enter
a value directly into the field, or click Select to return to the graphics window
and pick a position.
X
Displays the X coordinate for the position of the tool inspection. Select the checkbox and enter
a value directly into the field, or click Select to return to the graphics window
and pick a position.
Select
Returns you to the graphics window, where you can pick a position to define the
coordinates of the tool inspection point.
Absolute
Positions the tool inspection point relative to the tool plane origin.
Incremental
Positions the tool inspection point relative to the last point in the
toolpath before the tool inspection.
Number of sections
Specify the number of sections to complete before tool inspection occurs. Available only when Section turning is active.
Number of passes
Specify the number of passes before tool inspection occurs. When
using this option, the tool inspection always occurs after a pass completes.
Length of cut
Specify the cut length before tool inspection occurs. The length
of rapid and entry/exit moves is not considered when calculating the cut length.
When using Length of cut as a condition, tool inspection can occur during a pass,
unless you also have Only between passes selected.
Time in cut
Specify the time spent in a cut before tool inspection occurs.
Time spent in rapid and entry/exit moves is not considered when calculating the cut
time. When using Time in cut as a condition, tool inspection can occur during a pass,
unless you also have Only between passes selected.
End of operation
Select this option to perform a tool inspection at the end of the operation.
Only between passes
Ensures that tool inspection occurs only after a pass is complete.
Exact length and time
Select to let tool inspection occur during a pass. In this case, use
the Lead in/out distance and Start/end of pass allowance values to determine exactly
when the tool inspection can occur.
Use lead in/out
Sets the inspection process to use the values from the Lead In/Out dialog.
Lead in/out distance
Specify the distance to retract, at a linear feed rate, when exiting
the cut for a tool inspection and when reentering the cut after the tool inspection.
Mastercam calculates the lead in/out direction automatically.
Start/end of pass allowance
Specify how close to the start or end of a pass that a tool inspection
can occur. If the tool is closer to the start or end of the pass than specified,
Mastercam forces the tool inspection to occur before the pass begins or after the
pass completes.
Output comment
Outputs a comment to the NC file. Select to activate the field, in which you can enter a comment to be included in the NC file where the
tool stops. Enter comments such as "inspect tool", "clean out chips", or
any other relevant information regarding that programmed stop.