Trimming Toolpaths
A trim operation is a special type of operation which lets you select
one or more toolpaths and trim them to one or more closed chains. Trim
operations are similar to containment boundaries or check surfaces, but
can be more flexible because:
- They let you select a plane that you can
trim relative to.
- You can trim any type of toolpath except
multiaxis toolpaths.
- You can trim more than one toolpath with
the same trim operation.
When you create a trim operation, Mastercam stores it in the Toolpaths
Manager like any other operation. It also keeps the original source operation,
marking it with a special Trim icon.
The trim operation and source operations are associative with each other,
which means you can edit the parameters for each operation separately
and update the other operation by regenerating it. When you post, you
only select the source toolpaths (in this case, the pocket toolpath),
you do not post the Trimmed operation itself.
Trim operation
guidelines
To create a trim
operation, follow this general outline:
- First, create the source toolpaths
and the trim geometry. Note that Mastercam trims the toolpath
right to the trim geometry, without regard to cutter compensation,
so you might need to offset the trim geometry from the desired
boundary by the width of the tool. The trim geometry needs
to be a closed contour, but it does not have to be at the
same z depth as the part geometry or tool moves; Mastercam
projects it in the trim operation's Cplane onto the toolpath
to calculate the intersections with the toolpath.
- Select Trim
on the selected machine's Toolpaths tab. You will be prompted
to select the boundary chains, and then a point (called a
bias point) which tells Mastercam on which side of the boundary
you want to keep the tool movements. For example, if you were
trying to contain a toolpath inside a circle, click anywhere
inside the circle.
- Use the Trimmed
dialog box to select the toolpaths to trim. You can also
edit or reselect the bias point. Click T/C
Plane to select a different Cplane to use as
the trimming plane, if desired. The Cplane you select determines
how Mastercam calculates the intersection
of the boundary geometry and the toolpath.
- Choose OK
in the Trimmed dialog box to complete the operation. Both
the original operation and the trim operation appear in the
Toolpaths Manager. When you are ready to cut the part, you
only need to post the source operation. If you delete the
trim operation, you will need to regenerate the original toolpath.