Trimming Toolpaths

A trim operation is a special type of operation which lets you select one or more toolpaths and trim them to one or more closed chains. Trim operations are similar to containment boundaries or check surfaces, but can be more flexible because:

  • They let you select a plane that you can trim relative to.
  • You can trim any type of toolpath except multiaxis toolpaths.
  • You can trim more than one toolpath with the same trim operation.

When you create a trim operation, Mastercam stores it in the Toolpaths Manager like any other operation. It also keeps the original source operation, marking it with a special Trim icon.

A trim operation in the Toolpaths Manager.

The trim operation and source operations are associative with each other, which means you can edit the parameters for each operation separately and update the other operation by regenerating it. When you post, you only select the source toolpaths (in this case, the pocket toolpath), you do not post the Trimmed operation itself.

ClosedTrim operation guidelines

To create a trim operation, follow this general outline:

  • First, create the source toolpaths and the trim geometry. Note that Mastercam trims the toolpath right to the trim geometry, without regard to cutter compensation, so you might need to offset the trim geometry from the desired boundary by the width of the tool. The trim geometry needs to be a closed contour, but it does not have to be at the same z depth as the part geometry or tool moves; Mastercam projects it in the trim operation's Cplane onto the toolpath to calculate the intersections with the toolpath.
  • Select Trim on the selected machine's Toolpaths tab. You will be prompted to select the boundary chains, and then a point (called a bias point) which tells Mastercam on which side of the boundary you want to keep the tool movements. For example, if you were trying to contain a toolpath inside a circle, click anywhere inside the circle.
  • Use the Trimmed dialog box to select the toolpaths to trim. You can also edit or reselect the bias point. Click T/C Plane to select a different Cplane to use as the trimming plane, if desired. The Cplane you select determines how Mastercam calculates the intersection of the boundary geometry and the toolpath.
  • Choose OK in the Trimmed dialog box to complete the operation. Both the original operation and the trim operation appear in the Toolpaths Manager. When you are ready to cut the part, you only need to post the source operation. If you delete the trim operation, you will need to regenerate the original toolpath.

Learn more